Select the Operation tab, which is divided up into areas.
Parameters in this area... Allow you to customize... Default Values the use of default values After Creation or Machining Process (MP) Instantiation what happens after creating machining operations or machining processes When Copying the duplication of geometry links Display tool path displays of operations User Interface dialog boxes of 3-axis surface machining operations Start Feedrate the feedrate at the start of operation.
Default Values
Select the check box
if you want operations to be created with the values used in the current
program.
The values and units of attributes at the creation step of an operation are
set to the values and units of the last edited and validated operation
whatever its type (that is, exit the operation definition dialog box using
OK).
Otherwise the default settings delivered with the application are used.
By default, this check box is selected.
After Creation or Machining Process (MP) Instantiation
Select the desired check boxes to specify conditions to be applied when you create machining operations or machining processes.
Sequence machining operation
Machining operations are automatically sequenced in the current program
after creation.
Otherwise, sequencing can be managed in the feature view.
Search compatible tool in previous operations
When creating an operation, if a compatible tool exists in a previous operation of the current program, it will be set in the new operation. Otherwise, the operation will be incomplete.
Use a default tool
When creating an operation, a search is done in the document to find a
compatible tool. If no compatible tool exists, a default one is created in
the document and set in the created operation.
If check box is not selected, no tool will be defined on the operation.
Note: These last two options are not available for creating operations through the Machining Process instantiation if a tooling query is used to find the tool.
Start edit mode (not available for machining processes)
When creating a machining operation, Edit mode is automatically started
to allow modifying parameters of the created operation.
Otherwise, the operation is added to the program but the machining
operation editor is not started.
MP instantiation: keep the absolute position of the tool axis
When a machining process is instantiated, the tool axes of the activities in the MP keep their absolute positions. Otherwise, if the check box is not selected, these positions are changed in order to keep the relative components of the tool axis.
By default, these check boxes are selected.
When Copying
Select the check box
if you want geometry links to be duplicated in a copied operation.
Otherwise the geometry must be defined for the copied operation.
Note: When this option is selected, if you copy an operation that references a machining feature (such as Machining area, Slope area or Rework area), the feature is not actually duplicated in the copied operation. However, the copied operation will reference the initial feature - this helps to factorize the geometry definition.
By default, this check box is selected. Performance is improved when this
check box is not selected.
Display
Select the check box if you want to display tool paths of operations in the current Part Operation.
By default, this check box is not selected.
User Interface
Select the check box if you want to have the possibility of simplifying the dialog boxes of machining operations (that is, you can display the minimum number of parameters necessary for a correct tool path). This setting is available for 3-axis surface machining operations only.
By default, this check box is not selected.
Start Feedrate
If the checkbox is
selected, the following paragraphs illustrate the expected behaviour.
Otherwise, the behaviour is the same as for V5R13 level.
If a clearance macro is defined and active on machining operation B (see figure below), the feedrate at the start of operation B is the feedrate of the transition path in the plane of the clearance macro.
If there is no clearance macro defined on operation B (or if a clearance macro is defined but inactive), the feedrate at the start of operation B in the figure below is:
- either rapid feedrate if the Set rapid feedrate at start of operations NC output option is set
- or the first feedrate of operation B (this may be the feedrate of the approach macro of operation B, for example).
By default, this check box is selected.