PP Tables and PP Word Syntaxes

PP Word Tables

You can create and manage Post-Processor word tables with NC Manufacturing products.

Sample PP word tables are delivered with the product in the ..\startup\manufacturing\PPTables folder. Each PP word table is stored in a unique text file with suffix pptable. These tables can be used as a basis for creating user-defined tables.

A PP word table can be defined for a specific machine tool and used in NC applications.
You can also define the general syntaxes of post-processor words. These syntaxes will be proposed when you want to create a PP instruction.

A PP word table comprises:

You can define for a given machine tool:

The NC Manufacturing product will resolve the parameters of these syntaxes and syntax sequences and generate the corresponding statements in the APT output.

Note:
TPRINT and NOTE are automatically included in the lists of major words with parameters and minor words respectively even if they are not specifically declared in the PP word table.

NC Commands

You can define for a given machine tool (i.e. post-processor) PP word syntaxes associated to particular NC commands.

An NC command is a machine function such as feedrate declaration (NC_FEEDRATE) or spindle activation (NC_SPINDLE_START).

A syntax comprises a major word and one or more syntax elements such as minor words, numerical values, lists and parameters.

A syntax that includes lists or parameters is a parameterized syntax (see example below):

*START_NC_COMMAND     NC_COMPENSATION
LOADTL/%MFG_TL_NUMBER,%MFG_TOOL_COMP
*END

Note that the & character indicates a list and the % character indicates a parameter. A list has a finite number of values. You can define only one syntax for each NC command.

The example below shows how lists can be used to define inch units for feeds and speeds:

*START_NC_COMMAND         NC_FEEDRATE
*START_LIST MFG_FEED_UNIT
IPM ,IPR
*END
FEDRAT/%MFG_FEED_VALUE,&MFG_FEED_UNIT
*END
/
*START_NC_COMMAND         NC_SPINDLE_START
*START_LIST MFG_SPNDL_UNIT
RPM ,SFM
*END
SPINDL/%MFG_SPNDL_SPEED,&MFG_SPNDL_UNIT,&MFG_SPNDL_WAY
*END
/
*START_NC_COMMAND         NC_SPINDLE_LATHE
*START_LIST MFG_SPNDL_UNIT
RPM ,SFM
*END
SPINDL/%MFG_SPNDL_SPEED,&MFG_SPNDL_UNIT
*END

The example below shows how lists can be used to define metric units for feeds and speeds:

*START_NC_COMMAND         NC_FEEDRATE
*START_LIST MFG_FEED_UNIT
MMPM ,MMPR
*END
FEDRAT/%MFG_FEED_VALUE,&MFG_FEED_UNIT
*END
/
*START_NC_COMMAND         NC_SPINDLE_START
*START_LIST MFG_SPNDL_UNIT
RPM ,SMM
*END
SPINDL/%MFG_SPNDL_SPEED,&MFG_SPNDL_UNIT,&MFG_SPNDL_WAY
*END
/
*START_NC_COMMAND         NC_SPINDLE_LATHE
*START_LIST MFG_SPNDL_UNIT
RPM ,SMM
*END
SPINDL/%MFG_SPNDL_SPEED,&MFG_SPNDL_UNIT
*END

For an example of how to define syntaxes in NC commands, please see PP Word Syntaxes in the Customizing section of this guide.

Arithmetic Operators

It is possible to use the following arithmetic operators in PP word syntaxes:

These operators can be used:

Parenthesis are not needed in expressions: they will be ignored and will not appear in NC data output. For example:

WORD/%MFG_aaa, %MFG_xxx + %MFG_yyy, %MFG_bbb/2

Operators are processed in the order they appear in the syntax. For example:

%MFG_xxx + %MFG_yyy * %MFG_zzz

This means that %MFG_xxx is added to %MFG_yyy, then this sum is multiplied by %MFG_zzz.

You should avoid using the +, -, *, / characters for other meanings. For example, you could use an underscore (_) instead of a dash (-) in the following expression to avoid any ambiguity:

PPRINT/DIAMETER-VALUE, %MFG_NOMINAL_DIAM

Syntaxes of NC Commands

NC command syntaxes that are supported in the current version are as follows:

NC Commands for Start Comments

NC_xxx_MO_START_COMMENT syntaxes allow an automatic output in the APT of instructions at the start of machining operations, which allows among other things to easily recognize the start of an operation, to know the type of the operation, or to launch functions automatically (start coolant, axis unlocking, activating a working mode, and so on).
A sample PP Table (PPTableSampleMOComment.pptable) is delivered in the ..\startup\manufacturing\PPTables folder.

NC_AXIAL_MO_START_COMMENT

For axial machining operations:

*START_NC_INSTRUCTION NC_AXIAL_MO_START_COMMENT
*START_SEQUENCE
PPRINT NC_AXIAL_MO_START_COMMENT BEGIN
PPRINT MACHINE OPERATION = %MFG_MO_TYPE
PPRINT OPERATION NAME = %MFG_MO_IDENTIFIER
PPRINT PATTERN NAME = %MFG_PATTERN_NAME
PPRINT TOOL ASSEMBLY = %MFG_TL_ASMBLY_ID
PPRINT NC_AXIAL_MO_START_COMMENT END
*END
*END

The following example shows the type of APT source that can be generated:

PPRINT NC_AXIAL_MO_START_COMMENT BEGIN
PPRINT MACHINE OPERATION = Drilling
PPRINT OPERATION NAME = Drilling.1
PPRINT PATTERN NAME = Hole.1
PPRINT TOOL ASSEMBLY = Drill_Diam10
PPRINT NC_AXIAL_MO_START_COMMENT END
PPRINT OPERATION NAME : Drilling.1
$$ Start generation of : Drilling.1
LOADTL/2,1
SPINDL/ 204.0000,SFM,CLW
RAPID
GOTO / 130.00000, -55.00000, 2.50000
CYCLE/DRILL, 52.886751, 2.500000, 0.200000,MMPR
GOTO / 130.00000, -55.00000, 0.00000
CYCLE/OFF

NC_3X_MO_START_COMMENT

For 3-axis milling operations:

*START_NC_INSTRUCTION NC_3X_MO_START_COMMENT
*START_SEQUENCE
PPRINT NC_3X_MO_START_COMMENT BEGIN
PPRINT MACHINE OPERATION = %MFG_MO_TYPE
PPRINT OPERATION NAME = %MFG_MO_IDENTIFIER
PPRINT TOOL ASSEMBLY = %MFG_TL_ASMBLY_ID
PPRINT NC_3X_MO_START_COMMENT END
*END
*END

NC_5X_MO_START_COMMENT

For 5-axis milling operations:

*START_NC_INSTRUCTION NC_5X_MO_START_COMMENT
*START_SEQUENCE
PPRINT NC_5X_MO_START_COMMENT BEGIN
PPRINT MACHINE OPERATION = %MFG_MO_TYPE
PPRINT OPERATION NAME = %MFG_MO_IDENTIFIER
PPRINT TOOL ASSEMBLY = %MFG_TL_ASMBLY_ID
PPRINT NC_5X_MO_START_COMMENT END
*END
*END

NC_LATHE_MO_START_COMMENT

For turning operations:

*START_NC_INSTRUCTION NC_LATHE_MO_START_COMMENT
*START_SEQUENCE
PPRINT NC_LATHE_MO_START_COMMENT BEGIN
PPRINT MACHINE OPERATION = %MFG_MO_TYPE
PPRINT OPERATION NAME = %MFG_MO_IDENTIFIER
PPRINT TOOL ASSEMBLY = %MFG_TL_ASMBLY_ID
PPRINT NC_LATHE_MO_START_COMMENT END
*END
*END

NC_MILL_MO_START_COMMENT

For 2.5-axis milling operations:

*START_NC_INSTRUCTION NC_MILL_MO_START_COMMENT
*START_SEQUENCE
PPRINT NC_MILL_MO_START_COMMENT BEGIN
PPRINT MACHINE OPERATION = %MFG_MO_TYPE
PPRINT OPERATION NAME = %MFG_MO_IDENTIFIER
PPRINT TOOL ASSEMBLY = %MFG_TL_ASMBLY_ID
PPRINT NC_MILL_MO_START_COMMENT END
*END
*END

NC Commands for End Comments

NC_xxx_MO_END_COMMENT syntaxes allow an automatic output in the APT of instructions at the end of machining operations (stop spindle rotation, stop coolant, axis locking / unlocking, deactivating a working mode, and so on) and to easily recognize the end of operations. This allows the PP to stop reading ahead of the APT if it is searching an instruction only inside the current operation, for example. This avoids the need to manually insert APT words, which is not always possible.

NC_AXIAL_MO_END_COMMENT

For axial machining operations:

*START_NC_INSTRUCTION NC_AXIAL_MO_END_COMMENT
*START_SEQUENCE
PPRINT NC_AXIAL_MO_END_COMMENT BEGIN
PPRINT MACHINE OPERATION = %MFG_MO_TYPE
PPRINT OPERATION NAME = %MFG_MO_IDENTIFIER
PPRINT PATTERN NAME = %MFG_PATTERN_NAME
PPRINT TOOL ASSEMBLY = %MFG_TL_ASMBLY_ID
PPRINT NC_AXIAL_MO_END_COMMENT END
*END
*END

The following example shows the type of APT source that can be generated:

$$ End generation of : Drilling.1
PPRINT NC_AXIAL_MO_END_COMMENT BEGIN
PPRINT MACHINE OPERATION = Drilling
PPRINT OPERATION NAME = Drilling.1
PPRINT PATTERN NAME = Hole.1
PPRINT TOOL ASSEMBLY = Drill_Diam10
PPRINT NC_AXIAL_MO_END_COMMENT END
PPRINT OPERATION NAME : Drilling.1

NC_3X_MO_END_COMMENT

For 3-axis milling operations:

*START_NC_INSTRUCTION NC_3X_MO_END_COMMENT
*START_SEQUENCE
PPRINT NC_3X_MO_END_COMMENT BEGIN
PPRINT MACHINE OPERATION = %MFG_MO_TYPE
PPRINT OPERATION NAME = %MFG_MO_IDENTIFIER
PPRINT TOOL ASSEMBLY = %MFG_TL_ASMBLY_ID
PPRINT NC_3X_MO_END_COMMENT END
*END
*END

NC_5X_MO_END_COMMENT

For 5-axis milling operations:

*START_NC_INSTRUCTION NC_5X_MO_END_COMMENT
*START_SEQUENCE
PPRINT NC_5X_MO_END_COMMENT BEGIN
PPRINT MACHINE OPERATION = %MFG_MO_TYPE
PPRINT OPERATION NAME = %MFG_MO_IDENTIFIER
PPRINT TOOL ASSEMBLY = %MFG_TL_ASMBLY_ID
PPRINT NC_5X_MO_END_COMMENT END
*END
*END

NC_LATHE_MO_END_COMMENT

For turning operations:

*START_NC_INSTRUCTION NC_LATHE_MO_END_COMMENT
*START_SEQUENCE
PPRINT NC_LATHE_MO_END_COMMENT BEGIN
PPRINT MACHINE OPERATION = %MFG_MO_TYPE
PPRINT OPERATION NAME = %MFG_MO_IDENTIFIER
PPRINT TOOL ASSEMBLY = %MFG_TL_ASMBLY_ID
PPRINT NC_LATHE_MO_END_COMMENT END
*END
*END

NC_MILL_MO_END_COMMENT

For 2.5-axis milling operations:

*START_NC_INSTRUCTION NC_MILL_MO_END_COMMENT
*START_SEQUENCE
PPRINT NC_MILL_MO_END_COMMENT BEGIN
PPRINT MACHINE OPERATION = %MFG_MO_TYPE
PPRINT OPERATION NAME = %MFG_MO_IDENTIFIER
PPRINT TOOL ASSEMBLY = %MFG_TL_ASMBLY_ID
PPRINT NC_MILL_MO_END_COMMENT END
*END
*END

Other NC Commands

NC_AXIS_LOCK

Allows blocking a linear or rotary axis.
See Displacing and Locking Linear and Rotary Axes for more information.

MFG_AXIS_LOCK_STATUS:lock status of NC axis
MFG_NCAXIS_NAME:name of NC axis

NC_AXIS_MOVE

Allows linear displacement.
See Displacing and Locking Linear and Rotary Axes for more information.

MFG_NCAXIS_NAME: name of NC axis
MFG_AXIS_POSITION: position if NC axis

NC_CHANGE_REF_PT

Allows selecting the tool compensation corresponding to the desired tool output point.

MFG_QUADRANT: Number of the compensation type (for example, 2 for compensation type P2)

MFG_TL_SET_X: Tool assembly set length in x direction
MFG_TL_SET_Y: Tool assembly set length in y direction
MFG_TL_SET_Z: Tool assembly set length in z direction
MFG_NOSE_RADIUS: Insert nose radius
MFG_CMP_TL_SET_X: Computed Tool Assembly set length in X direction
MFG_CMP_TL_SET_Y: Computed Tool Assembly set length in Y direction
MFG_CMP_TL_SET_Z: Computed Tool Assembly set length in Z direction
MFG_CMP_NOSE_RADIUS: Nose radius corresponding to the active compensation point (left or right). Nose radius could be different for groove insert (left radius, right radius), when changing the active compensation point automatically. For other inserts (diamond, square, and so on) the value is the insert radius.

MFG_LGTH_COR_REG, MFG_TOOL_COMP and MFG_TL_COMP (compatibility V4): number of the correction register.

Default syntax: SWITCH/%MFG_QUADRANT
Syntax example for turning operations:
SWITCH/%MFG_TL_COMP,%MFG_QUADRANT,INCR,%MFG_TL_SET_X,%MFG_TL_SET_Z,%MFG_NOSE_RADIUS

NC_COMMENT

MFG_MO_COMMENT: comment defined on machining operation.

Default syntax: %MFG_MO_COMMENT

NC_COMPENSATION

MFG_TOOL_COMP and MFG_TL_COMP (compatibility V4): value of the tool compensation length
MFG_TL_COMP_RAD: value of the tool compensation radius
MFG_TL_NUMBER: tool number associated to the compensation
MFG_TL_NAME: name of tool associated to the compensation.

Default syntax: LOADTL/%MFG_TL_NUMBER,%MFG_TL_COMP

NC_CUTCOM_ON

The syntax of this NC command is CUTCOM/ON and cannot be parameterized.

NC_CUTCOM_OFF

The syntax of this NC command is CUTCOM/OFF and cannot be parameterized.

NC_CUTCOM_NORMDS_ON

The syntax of this NC command is CUTCOM/SAME, NORMDS and cannot be parameterized.

NC_CUTCOM_NORMDS_OFF

The syntax of this NC command is CUTCOM/OFF and cannot be parameterized.

NC_CUTCOM_NORMPS_ON

The syntax of this NC command is CUTCOM/NORMPS and cannot be parameterized.

NC_CUTCOM_NORMPS_OFF

The syntax of this NC command is CUTCOM/OFF and cannot be parameterized.

NC_CUTCOM_LEFT

The syntax of this NC command is CUTCOM/LEFT and cannot be parameterized.

NC_CUTCOM_RIGHT

The syntax of this NC command is CUTCOM/RIGHT and cannot be parameterized.

NC_DELAY

MFG_DELAY_UNIT: list with two values defining the delay units.
First value: delay expressed in number of revolutions.
REV is the default value.
Second value: delay expressed in seconds.
A blank string (represented by 8 underscore characters) is the default value. When the statement is generated by the application this string is ignored.
MFG_DELAY_VALUE: numerical value of the delay.

Default syntax: DELAY/%MFG_DELAY_VALUE,&MFG_DELAY_UNIT

NC_FEEDRATE

MFG_FEED_UNIT: list with two values defining the feedrate units.
First value: feedrate expressed in model units per minute. MMPM is the default value.
Second value: feedrate expressed in model units per revolution. MMPR is the default value.
MFG_FEED_VALUE: numerical value of the feedrate.

Default syntax: FEDRAT/%MFG_FEED_VALUE,&MFG_FEED_UNIT

task targetNC_HELICAL_INTERPOLATION

%MFG_HELICAL_X_CENTER: X coordinate of the helix center (output in the current machining axis);
this point is defined on the plane perpendicular to the helix axis and includes the helix start point.
%MFG_HELICAL_Y_CENTER: Y coordinate of the helix center (output in the current machining axis);
this point is defined on the plane perpendicular to the helix axis and includes the helix start point.
%MFG_HELICAL_Z_CENTER: Z coordinate of the helix center (output in the current machining axis);
this point is defined on the plane perpendicular to the helix axis and includes the helix start point.
%MFG_HELICAL_INDIRV_I: I component of the tangent at the helix start point
%MFG_HELICAL_INDIRV_J: J component of the tangent at the helix start point
%MFG_HELICAL_INDIRV_K: K component of the tangent at the helix start point
%MFG_HELICAL_I_AXIS: I component of helix axis
%MFG_HELICAL_J_AXIS: J component of helix axis
%MFG_HELICAL_K_AXIS: K component of helix axis
%MFG_HELICAL_PITCH: helix pitch
%MFG_HELICAL_RADIUS: helix radius
%MFG_HELICAL_ X_END: X coordinate of the helix end point (output in the current machining axis)
%MFG_HELICAL_ Y_END: Y coordinate of the helix end point (output in the current machining axis)
%MFG_HELICAL_ Z_END: Z coordinate of the helix end point (output in the current machining axis)
%MFG_HELICAL_ANGLE: helix angle
%MFG_HELICAL_HEIGHT: helix height
%MFG_HELICAL_ROUND: number of turns of the helix

Default syntax, which is defined with required parameters only:
HELICAL/, %MFG_HELICAL_ X_CENTER, %MFG_HELICAL_Y_CENTER, %MFG_HELICAL_ Z_CENTER,
%MFG_HELICAL_INDIRV_I, %%MFG_HELICAL_INDIRV_J, %MFG_HELICAL_INDIRV_K,
%MFG_HELICAL_I_AXIS, %MFG_HELICAL_J_AXIS, %MFG_HELICAL_K_AXIS, %MFG_HELICAL_PITCH,
%MFG_HELICAL_RADIUS, %MFG_HELICAL_ X_END, %MFG_HELICAL_ Y_END, %MFG_HELICAL_ Z_END

NC_MACHINING_AXIS

The syntax of this NC command is as follows:

$$*CATIA0
$$ %MFG_NCAXIS_IDENTIFIER
$$ %MFG_NCAXIS_X_VECX %MFG_NCAXIS_X_VECY %MFG_NCAXIS_X_VECZ %MFG_NCAXIS_X_ORIG
$$ %MFG_NCAXIS_Y_VECX %MFG_NCAXIS_Y_VECY %MFG_NCAXIS_Y_VECZ %MFG_NCAXIS_Y_ORIG
$$ %MFG_NCAXIS_Z_VECX %MFG_NCAXIS_Z_VECY %MFG_NCAXIS_Z_VECZ %MFG_NCAXIS_Z_ORIG

The syntax of this NC command for a multi-slide lathe machine environment is as follows:

$$*CATIA0
$$ %MFG_NCAXIS_IDENTIFIER, %MFG_SPINDLE_NAME, %MFG_SPINDLE_NUMBER
$$ %MFG_NCAXIS_X_VECX %MFG_NCAXIS_X_VECY %MFG_NCAXIS_X_VECZ %MFG_NCAXIS_X_ORIG
$$ %MFG_NCAXIS_Y_VECX %MFG_NCAXIS_Y_VECY %MFG_NCAXIS_Y_VECZ %MFG_NCAXIS_Y_ORIG
$$ %MFG_NCAXIS_Z_VECX %MFG_NCAXIS_Z_VECY %MFG_NCAXIS_Z_VECZ %MFG_NCAXIS_Z_ORIG

The parameters are as follows:

MFG_NCAXIS_IDENTIFIER: manufacturing program name for the first output, otherwise name of the machining axis change
MFG_SPINDLE_NAME: name of the spindle that is linked to the origin
MFG_SPINDLE_NUMBER: number of the spindle that is linked to the origin
MFG_NCAXIS_X_ORIG, MFG_NCAXIS_Y_ORIG, MFG_NCAXIS_Z_ORIG: coordinates of the machining axis origin
MFG_NCAXIS_X_VECX, MFG_NCAXIS_Y_VECX, MFG_NCAXIS_Z_VECX: components of the x-axis
MFG_NCAXIS_X_VECY, MFG_NCAXIS_Y_VECY, MFG_NCAXIS_Z_VECY: components of the y-axis
MFG_NCAXIS_X_VECZ, MFG_NCAXIS_Y_VECZ, MFG_NCAXIS_Z_VECZ: components of the z-axis.

See Displacing and Locking Linear and Rotary Axes for more information.

task targetNC_MILL_TURRET_INVERSION

The syntax of this NC command is as follows:

*START_NC_COMMAND NC_MILL_TURRET_INVERSION
*START_SEQUENCE
ROTATE/CAXIS,%MFG_MILL_TURRET_AXIS_INVERT
*END
*END

Parameter is the following:
%MFG_MILL_TURRET_AXIS_INVERT: value of this parameter indicates whether the mill turret is at inverted position or not
Possible values:
0: not inverted (C-axis = 0 degree)
1: inverted (C-axis = 180 degrees)

Notes:

task targetNC_MILL_TURRET_ORIENTATION

The syntax of this NC command is as follows:

*START_NC_COMMAND NC_MILL_TURRET_ORIENTATION
BAXIS,/%MFG_MILL_TURRET_I_AXIS, %MFG_MILL_TURRET_J_AXIS, MFG_MILL_TURRET_K_AXIS
*END

Parameters are the following:
% MFG_MILL_TURRET_I_AXIS: I component of tool axis orientation
% MFG_MILL_TURRET_J_AXIS: J component of tool axis orientation
% MFG_MILL_TURRET_K_AXIS: K component of tool axis orientation

Coordinates are defined in the machining axis (spindle axis system).

NC_MULTAX_ON

The syntax of this NC command is MULTAX and cannot be parameterized.

NC_MULTAX_OFF

The syntax of this NC command is MULTAX/OFF and cannot be parameterized.

NC_PITCH

MFG_THREAD_PITCH: Thread pitch 
MFG_NUM_THREADS: Number of threads.

Syntax examples:
PITCH/%MFG_THREAD_PITCH

PITCH/(1/%MFG_THREAD_PITCH),MULTRD,%MFG_NUM_THREADS
FEDRAT/%MFG_THREAD_PITCH,MMPR

NC_SPINDLE_ON

The syntax of this NC command is SPINDL/ON and cannot be parameterized.

NC_SPINDLE_START or NC_SPINDLE

MFG_SPNDL_UNIT: list with two values defining the spindle rotation units.
First value: spindle rotation expressed in revolutions per minute. RPM is the default value.
Second value: spindle rotation expressed in surface meters per minute. SMM is the default value.
MFG_SPNDL_WAY: list with two values defining the direction of rotation of the spindle.
First value: spindle rotation processed clockwise. CLW is the default value.
Second value: spindle rotation processed counter-clockwise. CCLW is the default value.
MFG_SPNDL_SPEED: numerical value of the spindle speed.
MFG_SPNDL_DIAMTR: diameter of the tool where the spindle speed is taken into account.

Default syntax: SPINDL/%MFG_SPNDL_SPEED,&MFG_SPNDL_UNIT,&MFG_SPNDL_WAY

NC_SPINDLE_LATHE

Note that this corresponds to the part's spindle speed.

MFG_SPNDL_UNIT: list with two values defining the spindle rotation units.
First value: spindle rotation expressed in revolutions per minute. RPM is the default value.
Second value: spindle rotation expressed in surface meters per minute. SMM is the default value.
MFG_SPNDL_WAY: list with two values defining the direction of rotation of the spindle.
First value: spindle rotation processed clockwise. CLW is the default value.
Second value: spindle rotation processed counter-clockwise. CCLW is the default value.
MFG_SPNDL_SPEED: numerical value of the spindle speed.

Default syntax: SPINDL/%MFG_SPNDL_SPEED,&MFG_SPNDL_UNIT

NC_SPINDLE_STOP

This NC command ensures compatibility with V4. You should use NC_SPINDLE_LOCK or NC_SPINDLE_OFF, if possible.

MFG_SPNDL_STOP: list with two values defining the action applied to the spindle.
First value: de-activation of the spindle. OFF is the default value.
Second value: spindle locked in an indexed position. LOCK is the default value.

NC_SPINDLE_LOCK

The syntax of this NC command is SPINDL/LOCK and cannot be parameterized.

NC_SPINDLE_OFF

The syntax of this NC command is SPINDL/OFF and cannot be parameterized.

NC_THREAD_TURN

Syntax example: THREAD/TURN

NC_THREAD_TURN_OFF

Ends a NC_THREAD_TURN statement.

Syntax example:

*START_NC_COMMAND         NC_THREAD_TURN_OFF
THREAD/OFF
*END

NC Instructions

You can define for a given machine tool (i.e. post-processor) sequences of PP word syntaxes associated to particular NC instructions.

NC instructions are either auxiliary commands or axial machining operations.

A syntax comprises a major word and one or more syntax elements such as minor words, numerical values and standard parameters. A set of standard parameters is associated to each NC instruction. Parameters may be combined in arithmetical expressions.

A syntax that includes parameters is a parameterized syntax (see examples below):

*START_NC_INSTRUCTION   NC_TOOL_CHANGE
*START_SEQUENCE
TOOLNO/%MFG_TOOL_NUMBER,%MFG_NOMINAL_DIAM
TPRINT/%MFG_TOOL_NAME
LOADTL/%MFG_TOOL_NUMBER
*END
*END

*START_NC_INSTRUCTION      NC_TAPPING
*START_SEQUENCE
CYCLE/TAP,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP
*END
*END

Note that the % character indicates a parameter.

You can define one or more syntax sequences for each NC instruction.

For an example of how to define syntax sequences in NC Instructions, please see PP Word Syntaxes in the Customizing section of this guide.

Standard Parameters for Auxiliary Command Type NC Instructions

These parameters include data that is defined on the corresponding entity or parameters that are computed according to an application method.

Auxiliary command type NC Instructions are as follows:

NC_ACTIVITY_HEADER

This instruction is used to valuate parameters of an activity during the generation of APT.

Default syntax (empty):
*START_NC_INSTRUCTION      NC_ACTIVITY_HEADER
*START_SEQUENCE
*END
*END

Syntax example:
$$ OPERATION NAME = %MFG_MO_IDENTIFIER

NC_END_MACRO

MFG_IDENTIFIER: Part Operation identifier
MFG_MACHINE_NAME: Machine name.

Default syntax: SPINDL/OFF

NC_HEAD_ROTATION

MFG_TYPE_OF_ROT: Rotation type (absolute angle in this version)
MFG_DIR_OF_ROT: Rotation direction (clockwise or counterclockwise)
MFG_AMOUNT_ROT: Angle of rotation about the axis of rotation
MFG_AXIS_OF_ROT: Axis of rotation on machine head.
MFG_ABC_AXIS: Axis of rotation on machine head to get Minor word AAXIS, BAXIS or CAXIS.

See Displacing and Locking Linear and Rotary Axes for more information.

Default syntax: ROTHED/%MFG_AMOUNT_ROT,%MFG_DIR_OF_ROT

NC_ORIGIN

MFG_NCAXIS_X_ORIG, MFG_NCAXIS_Y_ORIG, MFG_NCAXIS_Z_ORIG: coordinates of the origin
MFG_ORIGIN_NUMBER: origin number
MFG_ORIGIN_GROUP: origin group.

Default syntax: ORIGIN/%MFG_NCAXIS_X_ORIG,%MFG_NCAXIS_Y_ORIG,%MFG_NCAXIS_Z_ORIG,$
%MFG_ORIGIN_NUMBER,%MFG_ORIGIN_GROUP

NC_PROGRAM_HEADER

MFG_PROGRAM_NAME: Manufacturing Program name
MFG_CHANNEL_NUMBER: Channel number (Turret).

Default syntax (empty):
*START_NC_INSTRUCTION      NC_PROGRAM_HEADER
*START_SEQUENCE
*END
*END

Syntax example:
PROG_NAME,%MFG_PROGRAM_NAME

Syntax example in a Multi-Axis Lathe machine environment:
CHANNEL,%MFG_CHANNEL_NUMBER

NC_START_MACRO

MFG_IDENTIFIER: Part Operation identifier
MFG_PROGRAM_NAME: Manufacturing Program name
MFG_MACHINE_NAME: Machine name
MFG_MODEL_NAME: Name of the CATProcess (with document suffix)
MFG_PRODUCT_NAME: Name of the CATProduct/CATPart (with no document suffix).

Default syntax: PARTNO PART TO BE MACHINED

Note: When PARTNO is defined as a major word with text, if you want to use PARTNO with parameters for a clfile output, the "/" character must be replaced by a space.
You can use the  "/" character for an APT output.

NC_TABLE_ROTATION

MFG_TYPE_OF_ROT: Rotation type (absolute angle in this version)
MFG_DIR_OF_ROT: Rotation direction (clockwise or counterclockwise)
MFG_AMOUNT_ROT: Angle of rotation about the axis of rotation
MFG_AXIS_OF_ROT: Axis of rotation on machine table.
MFG_ABC_AXIS: Axis of rotation on machine table to get Minor word AAXIS, BAXIS or CAXIS.

Default syntax: ROTABL/%MFG_AMOUNT_ROT,%MFG_DIR_OF_ROT

See Displacing and Locking Linear and Rotary Axes for more information.

NC_TOOL_CHANGE

Please note that if tool assembly resources are not used in your process, the term 'tool assembly' means 'tool' or 'cutter' in the following description.

MFG_TL_ASMBLY_ID: Tool assembly identifier
MFG_TL_SET_LGTH: Tool set length
MFG_NOMINAL_DIAM: Nominal diameter of the tool
MFG_TOOL_COMMENT: Comment associated with the tool
MFG_TOOL_NUMBER: Tool assembly number
MFG_ASS_COMMENT: Comment associated with the tool assembly
MFG_WEIGHT_SNTX: Tool weight syntax
MFG_COOLNT_SNTX: Coolant supply syntax
MFG_TOOTH_DES: Tooth description
MFG_DIAMETER_2: Diameter 2 of the tool assembly
MFG_MAX_MIL_TIME: Tool life (in time units)
MFG_MAX_MIL_LGTH: Tool life (in length units)
MFG_CORNER_RAD: Tool corner radius
MFG_CUT_ANGLE: Tool cutting angle
MFG_LENGTH: Length of active part of the tool
MFG_TL_TIP_LGTH: Tool tip length
MFG_CUT_LENGTH: Tool cutting length
MFG_NB_OF_FLUTES: Number of teeth
MFG_TOOL_NAME: Tool name
MFG_TL_SET_X: Tool set length in x direction
MFG_TL_SET_Y: Tool set length in y direction
MFG_WAY_OF_ROT: Computed rotation direction of tool (RIGHTHAND or LEFTHAND)
MFG_TOOL_ASS_POW: Computed tool assembly power type
If fixed the value is TURN, otherwise the value is MILL
MFG_TOOL_COMP and MFG_TL_COMP (compatibility V4): value of the tool compensation length
MFG_TOOL_COMP_2: value of the second tool compensation length

MFG_FEED_MACH: Machining feedrate (*)
MFG_SPNDL_MACH: Machining spindle speed (*)
MFG_FEED_UNIT: Computed feedrate unit (*)
MFG_SPNDL_UNIT: Computed spindle speed unit (*)

(*) The values of these feed and speed attributes are taken from the first machining operation under the tool change.

Default syntax: TOOLNO/%MFG_TOOL_NUMBER,%MFG_NOMINAL_DIAM

NC_TOOL_CHANGE_LATHE

MFG_TL_ASMBLY_ID: Tool assembly identifier
MFG_ASS_COMMENT: Comment associated with the tool assembly
MFG_TOOL_NUMBER: Tool assembly number
MFG_TOOL_NAME: Insert-holder name
MFG_TOOL_COMMENT: Comment associated with the insert-holder
MFG_INSERT_NAME: Insert name
MFG_INSERT_COMMENT: Comment associated with the insert

MFG_QUADRANT: Number of the compensation type (for example, 2 for compensation type P2)
MFG_TL_SETUP_ANG: Tool assembly setup angle (value in degrees)
MFG_TL_SET_X: Tool assembly set length in x direction
MFG_TL_SET_Y: Tool assembly set length in y direction 
MFG_TL_SET_Z: Tool assembly set length in z direction
MFG_NOSE_RADIUS: Insert nose radius

MFG_CMP_TL_SET_X: Computed Tool Assembly set length in X direction
MFG_CMP_TL_SET_Y: Computed Tool Assembly set length in Y direction
MFG_CMP_TL_SET_Z: Computed Tool Assembly set length in Z direction
MFG_CMP_NOSE_RADIUS: Nose radius corresponding to the active compensation point (left or right). Nose radius could be different for groove insert (left radius, right radius), when changing the active compensation point automatically. For other inserts (diamond, square, and so on) the value is the insert radius.

MFG_HAND_STYLE: Insert-holder style (LEFT_HAND, RIGHT_HAND or NEUTRAL)
MFG_TOOL_INVERT: Tool assembly inversion. Defines if the insert-holder has been inverted with respect to the original insert-holder style. Possible values are 0 (not inverted) or 1 (inverted).
MFG_TOOL_COMP and MFG_TL_COMP (compatibility V4): Value of the insert-holder compensation length

MFG_LIFE_TIME: Insert life-time (in time units). Not available for Groove inserts.
MFG_CLEAR_ANGLE: Insert clearance angle
MFG_INSERT_LGTH: Insert length
MFG_INSCRIB_DIAM: Inscribed diameter of insert
MFG_INSERT_ANGLE: Insert shape angle

MFG_SPNDL_WAY: Spindle direction
MFG_FEED_MACH: Machining feedrate (*)
MFG_FEED_UNIT: Feedrate unit (*)
MFG_SPNDL_MACH: Machining spindle speed (*)
MFG_SPNDL_UNIT: Spindle speed unit (*).

(*) The values of these feed and speed attributes are taken from the first machining operation under the tool change.

Default syntax: TOOLNO/%MFG_TOOL_NUMBER,TURN

Mill/Turn integration and the NC_TOOL_CHANGE_LATHE instruction

For a drilling operation using a non-powered Milling Tool Assembly and machining along the spindle axis, a Lathe Tool Change is created. In this case, the following Insert attributes are replaced by Tool attributes:

Insert attributes
MFG_NOSE_RADIUS
MFG_INSCRIB_DIAM
MFG_LIFE_TIME
MFG_LIFE_LGTH
MFG_INSERT_LGTH
MFG_CLEAR_ANGLE
MFG_INSERT_ANGLE
  Tool attributes
 MFG_NOMINAL_DIAM
 MFG_NOMINAL_DIAM
 MFG_MAX_MIL_TIME
 MFG_MAX_MIL_LGTH
 MFG_CUT_LENGTH
 0 (not valuated)
 MFG_CUT_ANGLE

Displacing and Locking Linear and Rotary Axes

Machine instructions have a customizable format in the PP table.
They can contain the following information.

Linear displacements:

Default format for a linear displacement:

PPFUN/ <Letter of the axis>,<Letter of the axis>AXIS,value of the displacement

Otherwise, it can be customized in the PP table by means of NC_AXIS_MOVE.

/
*START_NC_COMMAND NC_AXIS_MOVE
CLAMP/OFF,%MFG_NCAXIS_NAME,%MFG_AXIS_POSITION
*END
/

Rotary displacements:

Format for a rotary displacement:

ROTABL/value of the rotation,<rotary direction >,<rotation axis>

Otherwise, it can be customized in the PP table by means of the NC instructions NC_TABLE_ROTATION, NC_MACHINING_AXIS and NC_HEAD_ROTATION.

/
*START_NC_INSTRUCTION NC_HEAD_ROTATION
*START_SEQUENCE
ROTHED/%MFG_AMOUNT_ROT,%MFG_DIR_OF_ROT
*END
*END
/
*START_NC_INSTRUCTION NC_TABLE_ROTATION
*START_SEQUENCE
ROTABL/%MFG_AMOUNT_ROT,%MFG_DIR_OF_ROT,%MFG_ABC_AXIS
*END
*END
/
*START_NC_INSTRUCTION NC_MACHINING_AXIS
*START_SEQUENCE
$$ %MFG_NCAXIS_IDENTIFIER
$$ %MFG_NCAXIS_X_VECX %MFG_NCAXIS_X_VECY %MFG_NCAXIS_X_VECZ %MFG_NCAXIS_X_ORIG
$$ %MFG_NCAXIS_Y_VECX %MFG_NCAXIS_Y_VECY %MFG_NCAXIS_Y_VECZ %MFG_NCAXIS_Y_ORIG
$$ %MFG_NCAXIS_Z_VECX %MFG_NCAXIS_Z_VECY %MFG_NCAXIS_Z_VECZ %MFG_NCAXIS_Z_ORIG
CATMAT/%MFG_NCAXIS_X_ORIG,%MFG_NCAXIS_Y_ORIG,%MFG_NCAXIS_Z_ORIG,%MFG_NCAXIS_X_VECX,%MFG_NCAXIS_X_VECY,%MFG_NCAXIS_X_VECZ,%MFG_NCAXIS_Y_VECX,%MFG_NCAXIS_Y_VECY,%MFG_NCAXIS_Y_VECZ,%MFG_NCAXIS_Z_VECX,%MFG_NCAXIS_Z_VECY,%MFG_NCAXIS_Z_VECZ,%MFG_NCAXIS_IDENTIFIER
*END
*END

To block a linear or rotary axis:

If the axis is blocked:

LOCK/ <Letter of the axis>,<Letter of the axis>AXIS,ON

Otherwise, it can be customized in the PP table by means of NC_AXIS_LOCK

/
*START_NC_COMMAND NC_AXIS_LOCK
CLAMP/%MFG_AXIS_LOCK_STATUS,%MFG_NCAXIS_NAME
*END
/

Standard Parameters for Axial Machining Operation Type NC Instructions

For axial machining operations, the standard parameters are either:

In the figures below:

Overall breakthrough is the breakthrough distance plus the tool tip length.

Figure 1. Total depth without breakthrough

Figure 2. Total depth with breakthrough

The figures below show Depth mode behavior on axial operations with chamfering machining:

Figure 3. Spot Drilling with Depth mode=By Tip

Figure 4. Countersinking with Depth mode=By Diameter

Axial machining operation type NC Instructions are as follows:

NC_BACK_BORING

General parameters are as follows:

MFG_MO_TYPE: Machining operation type
MFG_MO_IDENTIFIER: Machining operation name or identifier
MFG_PATTERN_NAME: Machining pattern name.

Feeds and Speeds parameters are as follows:

MFG_FEED_APP_MODE: Approach feedrate mode (0: Value / 1: Rapid)
MFG_FEED_APP_VALUE and MFG_FEED_APPRCH (compatibility V4): Approach feedrate
MFG_FEED_PLUNGE_MODE and MFG_FEED_PL_TYPE (compatibility V4): Plunge feedrate mode (0: Value / 1: Rapid)
MFG_FEED_PLUNGE_VALUE and MFG_PLUNGE_FEED (compatibility V4): Plunge feedrate
MFG_FEED_MACH_VALUE and MFG_FEED_MACH (compatibility V4): Machining feedrate
MFG_SPINDLE_MACH_VALUE and MFG_SPNDL_MACH (compatibility V4): Machining spindle speed
MFG_FEED_RETRACT_MODE and MFG_FEED_RT_TYPE (compatibility V4): Retract feedrate mode (0: Value / 1: Rapid)
MFG_FEED_RETRACT_VALUE and MFG_FEED_RETRACT (compatibility V4): Retract feedrate
MFG_FEED_UNIT: Feedrate unit
MFG_SPNDL_UNIT: Spindle speed unit

Machining Strategy parameters are as follows:

MFG_CLEAR_TIP: Approach clearance
MFG_CLEAR_TIP_2: Second approach clearance
MFG_DEPTH_MODE: Depth mode (1: Tip / 2: Shoulder)
MFG_DWELL_MODE: Dwell mode (0: None / 1: By revolutions / 2: By time)
MFG_DWELL_REVOL: Dwell delay in revolutions
MFG_DWELL_TIME: Dwell delay in time units (seconds)
MFG_LIFT_MODE: Shift mode (0: None / 1: Linear coordinates / 2: Polar coordinates)
MFG_XOFF: Shift along X
MFG_YOFF: Shift along Y
MFG_ZOFF: Shift along Z
MFG_LIFT_ANGLE: Shift angle
MFG_LIFT_DIST: Shift distance
MFG_RETRACT_CLEAR_TIP: retract clearance
MFG_TOOL_COMP and MFG_TL_COMP (compatibility V4): Length number of current corrector
MFG_TOOL_COMP_1: Length number of first corrector
MFG_TOOL_COMP_DIST: Distance between the position of the current corrector and the tool tip
MFG_TOOL_COMP_DIST_1: Distance between the position of the first corrector and the tool tip

Geometry parameters are as follows:

MFG_DIAMETER: Nominal diameter of the tool
MFG_NOMINAL_DIAMETER: Nominal diameter of the machined feature
MFG_BCK_BORE_VAL: Back bore depth
MFG_JUMP_DIST: Jump distance

Computed parameters are as follows (see Figure 1 and Figure 2 above):

MFG_DETAIL_DEPTH: Hole depth that is effectively machined
MFG_TOTAL_DEPTH: Total depth machined by the operation. This includes the hole depth, breakthrough, and tool tip length.
MFG_TOTAL_DEPTH_COMP: Total depth machined by the operation up to the tool compensation point selected for the operation. This includes hole depth, breakthrough and tool tip length up to the compensation point.
MFG_CMP_DWL_TIME: Computed dwell delay (in time units of seconds): this parameter is computed if dwell mode is set to 'revolutions'. Otherwise, the dwell time is returned as is.
MFG_CMP_OFFSET: Computed offset
MFG_CMP_ANGLE: Computed angle. This parameter is computed if Shift mode is set to 'Linear coordinates'. Otherwise, the Shift angle is returned as is.

Default syntax: CYCLE/BORE,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP

NC_BORING

General parameters are as follows:

MFG_MO_TYPE: Machining operation type
MFG_MO_IDENTIFIER: Machining operation name or identifier
MFG_PATTERN_NAME: Machining pattern name.

Feeds and Speeds parameters are as follows:

MFG_FEED_APP_MODE: Approach feedrate mode (0: Value / 1: Rapid)
MFG_FEED_APP_VALUE and MFG_FEED_APPRCH (compatibility V4): Approach feedrate
MFG_FEED_PLUNGE_MODE and MFG_FEED_PL_TYPE (compatibility V4): Plunge feedrate mode (0: Value / 1: Rapid)
MFG_FEED_PLUNGE_VALUE and MFG_PLUNGE_FEED (compatibility V4): Plunge feedrate
MFG_FEED_MACH_VALUE and MFG_FEED_MACH (compatibility V4): Machining feedrate
MFG_SPINDLE_MACH_VALUE and MFG_SPNDL_MACH (compatibility V4): Machining spindle speed
MFG_FEED_RETRACT_MODE and MFG_FEED_RT_TYPE (compatibility V4): Retract feedrate mode (0: Value / 1: Rapid)
MFG_FEED_RETRACT_VALUE and MFG_FEED_RETRACT (compatibility V4): Retract feedrate
MFG_FEED_UNIT: Feedrate unit
MFG_SPNDL_UNIT: Spindle speed unit

Machining Strategy parameters are as follows:

MFG_CLEAR_TIP: Approach clearance
MFG_DEPTH_MODE: Depth mode (1: Tip / 2: Shoulder)
MFG_BREAKTHROUGH: Breakthrough distance
MFG_PLUNGE_MODE: Plunge mode (0: None / 1: Tip / 3: Diameter)
MFG_PLUNGE_TIP: Plunge tip distance
MFG_PLUNGE_OFFST: Plunge tip offset
MFG_PLUNGE_DIAMETER: Plunge diameter
MFG_DWELL_MODE: Dwell mode (0: None / 1: By revolutions / 2: By time)
MFG_DWELL_REVOL: Dwell delay in revolutions
MFG_DWELL_TIME: Dwell delay in time units (seconds)
MFG_TOOL_COMP and MFG_TL_COMP (compatibility V4): Length number of current corrector
MFG_TOOL_COMP_1: Length number of first corrector
MFG_TOOL_COMP_DIST: Distance between the position of the current corrector and the tool tip
MFG_TOOL_COMP_DIST_1: Distance between the position of the first corrector and the tool tip

Geometry parameters are as follows:

MFG_DIAMETER: Nominal diameter of tool
MFG_NOMINAL_DIAMETER: Nominal diameter of the machined feature
MFG_JUMP_DIST: Jump distance

Computed parameters are as follows (see Figure 1 and Figure 2 above):

MFG_DETAIL_DEPTH: Hole depth that is effectively machined
MFG_TOTAL_DEPTH: Total depth machined by the operation. This includes the hole depth, breakthrough, and tool tip length.
MFG_TOTAL_DEPTH_COMP: Total depth machined by the operation up to the tool compensation point selected for the operation. This includes hole depth, breakthrough and tool tip length up to the compensation point.
MFG_PLUNGE_DIST: Whatever the selected plunge mode (by Tip or by Diameter), this parameter returns the plunge distance. The plunge offset is taken into account in this value.
MFG_CMP_DWL_TIME: Computed dwell delay (in time units of seconds): this parameter is computed if dwell mode is set to 'revolutions'. Otherwise, the dwell time is returned as is.

Default syntax: CYCLE/BORE,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP

NC_BORING_SPINDLE_STOP

General parameters are as follows:

MFG_MO_TYPE: Machining operation type
MFG_MO_IDENTIFIER: Machining operation name or identifier
MFG_PATTERN_NAME: Machining pattern name.

Feeds and Speeds parameters are as follows:

MFG_FEED_APP_MODE: Approach feedrate mode (0: Value / 1: Rapid)
MFG_FEED_APP_VALUE and MFG_FEED_APPRCH (compatibility V4): Approach feedrate
MFG_FEED_PLUNGE_MODE and MFG_FEED_PL_TYPE (compatibility V4): Plunge feedrate mode (0: Value / 1: Rapid)
MFG_FEED_PLUNGE_VALUE and MFG_PLUNGE_FEED (compatibility V4): Plunge feedrate
MFG_FEED_MACH_VALUE and MFG_FEED_MACH (compatibility V4): Machining feedrate
MFG_SPINDLE_MACH_VALUE and MFG_SPNDL_MACH (compatibility V4): Machining spindle speed
MFG_FEED_RETRACT_MODE and MFG_FEED_RT_TYPE (compatibility V4): Retract feedrate mode (0: Value / 1: Rapid)
MFG_FEED_RETRACT_VALUE and MFG_FEED_RETRACT (compatibility V4): Retract feedrate
MFG_FEED_UNIT: Feedrate unit
MFG_SPNDL_UNIT: Spindle speed unit

Machining Strategy parameters are as follows:

MFG_CLEAR_TIP: Approach clearance
MFG_DEPTH_MODE: Depth mode (1: Tip / 2: Shoulder)
MFG_BREAKTHROUGH: Breakthrough distance
MFG_PLUNGE_MODE: Plunge mode (0: None / 1: Tip / 3: Diameter)
MFG_PLUNGE_TIP: Plunge tip distance
MFG_PLUNGE_OFFST: Plunge tip offset
MFG_PLUNGE_DIAMETER: Plunge diameter
MFG_DWELL_MODE: Dwell mode (0: None / 1: By revolutions / 2: By time)
MFG_DWELL_REVOL: Dwell delay in revolutions
MFG_DWELL_TIME: Dwell delay in time units (seconds)
MFG_LIFT_MODE: Shift mode (0: None / 1: Linear coordinates / 2: Polar coordinates)
MFG_XOFF: Shift along X
MFG_YOFF: Shift along Y
MFG_ZOFF: Shift along Z
MFG_LIFT_ANGLE: Shift angle
MFG_LIFT_DIST: Shift distance
MFG_TOOL_COMP and MFG_TL_COMP (compatibility V4): Length number of current corrector
MFG_TOOL_COMP_1: Length number of first corrector
MFG_TOOL_COMP_DIST: Distance between the position of the current corrector and the tool tip
MFG_TOOL_COMP_DIST_1: Distance between the position of the first corrector and the tool tip
.

Geometry parameters are as follows:

MFG_DIAMETER: Nominal diameter of tool
MFG_NOMINAL_DIAMETER: Nominal diameter of the machined feature
MFG_JUMP_DIST: Jump distance

Computed parameters are as follows (see Figure 1 and Figure 2 above):

MFG_DETAIL_DEPTH: Hole depth that is effectively machined
MFG_TOTAL_DEPTH: Total depth machined by the operation. This includes the hole depth, breakthrough, and tool tip length.
MFG_TOTAL_DEPTH_COMP: Total depth machined by the operation up to the tool compensation point selected for the operation. This includes hole depth, breakthrough and tool tip length up to the compensation point.
MFG_PLUNGE_DIST: Whatever the selected plunge mode (by Tip or by Diameter), this parameter returns the plunge distance. The plunge offset is taken into account in this value.
MFG_CMP_DWL_TIME: Computed dwell delay (in time units of seconds): this parameter is computed if dwell mode is set to 'revolutions'. Otherwise, the dwell time is returned as is.
MFG_CMP_OFFSET: Computed offset
MFG_CMP_ANGLE: Computed angle. This parameter is computed if Shift mode is set to 'Linear coordinates'. Otherwise, the Shift angle is returned as is.

Default syntax: CYCLE/BORE,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP

NC_BORING_AND_CHAMFERING

General parameters are as follows:

MFG_MO_TYPE: Machining operation type
MFG_MO_IDENTIFIER: Machining operation name or identifier
MFG_PATTERN_NAME: Machining pattern name.

Feeds and Speeds parameters are as follows:

MFG_FEED_APP_MODE: Approach feedrate mode (0: Value / 1: Rapid)
MFG_FEED_APP_VALUE and MFG_FEED_APPRCH (compatibility V4): Approach feedrate
MFG_FEED_PLUNGE_MODE and MFG_FEED_PL_TYPE (compatibility V4): Plunge feedrate mode (0: Value / 1: Rapid)
MFG_FEED_PLUNGE_VALUE and MFG_PLUNGE_FEED (compatibility V4): Plunge feedrate
MFG_FEED_MACH_VALUE and MFG_FEED_MACH (compatibility V4): Machining feedrate
MFG_SPINDLE_MACH_VALUE and MFG_SPNDL_MACH (compatibility V4): Machining spindle speed
MFG_CHAMFER_FEED_VALUE and MFG_CHAMFER_FEED (compatibility V4): Machining feedrate for chamfering phase
MFG_CHAMFER_SPINDLE_VALUE: Machining spindle speed for chamfering phase.
MFG_FEED_RETRACT_MODE and MFG_FEED_RT_TYPE (compatibility V4): Retract feedrate mode (0: Value / 1: Rapid)
MFG_FEED_RETRACT_VALUE and MFG_FEED_RETRACT (compatibility V4): Retract feedrate
MFG_FEED_UNIT: Feedrate unit
MFG_SPNDL_UNIT: Spindle speed unit

Machining Strategy parameters are as follows:

MFG_CLEAR_TIP: Approach clearance
MFG_CLEAR_TIP_2: Second approach clearance
MFG_DEPTH_MODE: Depth mode (1: Tip / 2: Shoulder)
MFG_BREAKTHROUGH: Breakthrough distance
MFG_PLUNGE_MODE: Plunge mode (0: None / 1: Tip / 3: Diameter)
MFG_PLUNGE_TIP: Plunge tip distance
MFG_PLUNGE_OFFST: Plunge tip offset
MFG_PLUNGE_DIAMETER: Plunge diameter
MFG_DWELL_MODE: Dwell mode (0: None / 1: By revolutions / 2: By time)
MFG_DWELL_REVOL: Dwell delay in revolutions
MFG_DWELL_TIME: Dwell delay in time units (seconds)
MFG_TOOL_COMP and MFG_TL_COMP (compatibility V4): Length number of current corrector
MFG_TOOL_COMP_1: Length number of first corrector
MFG_TOOL_COMP_2: Length number of second corrector
MFG_TOOL_COMP_DIST: Distance between the position of the current corrector and the tool tip
MFG_TOOL_COMP_DIST_1: Distance between the position of the first corrector and the tool tip
MFG_TOOL_COMP_DIST_2: Distance between the position of the second corrector and the tool tip

Geometry parameters are as follows:

MFG_DIAMETER and MFG_CHAMFER_VAL (compatibility V4): Chamfer diameter
MFG_NOMINAL_DIAMETER: Nominal diameter of the machined feature
MFG_JUMP_DIST: Jump distance.

Computed parameters are as follows (see Figure 1 and Figure 2 above):

MFG_DETAIL_DEPTH: Hole depth that is effectively machined.
MFG_TOTAL_DEPTH: Total depth machined by the operation. This includes the hole depth, breakthrough, and tool tip length.
MFG_TOTAL_DEPTH_COMP: Total depth machined by the operation up to the tool compensation point selected for the operation. This includes hole depth, breakthrough and tool tip length up to the compensation point.
MFG_PLUNGE_DIST: Whatever the selected plunge mode (by Tip or by Diameter), this parameter returns the plunge distance. The plunge offset is taken into account in this value.
MFG_CMP_DWL_TIME: Computed dwell delay (in time units of seconds): this parameter is computed if dwell mode is set to 'revolutions'. Otherwise, the dwell time is returned as is.

Default syntax: CYCLE/BORE,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP

NC_BREAK_CHIPS

General parameters are as follows:

MFG_MO_TYPE: Machining operation type
MFG_MO_IDENTIFIER: Machining operation name or identifier
MFG_PATTERN_NAME: Machining pattern name.

Feeds and Speeds parameters are as follows:

MFG_FEED_APP_MODE: Approach feedrate mode (0: Value / 1: Rapid)
MFG_FEED_APP_VALUE and MFG_FEED_APPRCH (compatibility V4): Approach feedrate
MFG_FEED_PLUNGE_MODE and MFG_FEED_PL_TYPE (compatibility V4): Plunge feedrate mode (0: Value / 1: Rapid)
MFG_FEED_PLUNGE_VALUE and MFG_PLUNGE_FEED (compatibility V4): Plunge feedrate
MFG_FEED_MACH_VALUE and MFG_FEED_MACH (compatibility V4): Machining feedrate
MFG_SPINDLE_MACH_VALUE and MFG_SPNDL_MACH (compatibility V4): Machining spindle speed
MFG_FEED_RETRACT_MODE and MFG_FEED_RT_TYPE (compatibility V4): Retract feedrate mode (0: Value / 1: Rapid)
MFG_FEED_RETRACT_VALUE and MFG_FEED_RETRACT (compatibility V4): Retract feedrate
MFG_FEED_UNIT: Feedrate unit
MFG_SPNDL_UNIT: Spindle speed unit

Machining Strategy parameters are as follows:

MFG_CLEAR_TIP: Approach clearance
MFG_DEPTH_MODE: Depth mode  (1: Tip / 2: Shoulder)
MFG_BREAKTHROUGH: Breakthrough distance
MFG_AXIAL_DEPTH: Maximum depth of cut
MFG_OFFSET_RET: Retract offset 
MFG_PLUNGE_MODE: Plunge mode (0: None / 1: Tip / 3: Diameter)
MFG_PLUNGE_TIP: Plunge tip distance
MFG_PLUNGE_OFFST: Plunge tip offset
MFG_PLUNGE_DIAMETER: Plunge diameter
MFG_DWELL_MODE: Dwell mode (0: None / 1: By revolutions / 2: By time)
MFG_DWELL_REVOL: Dwell delay in revolutions
MFG_DWELL_TIME: Dwell delay in time units (seconds)
MFG_TOOL_COMP and MFG_TL_COMP (compatibility V4): Length number of current corrector
MFG_TOOL_COMP_1: Length number of first corrector
MFG_TOOL_COMP_DIST: Distance between the position of the current corrector and the tool tip
MFG_TOOL_COMP_DIST_1: Distance between the position of the first corrector and the tool tip

Geometry parameters are as follows:

MFG_DIAMETER: Tool nominal diameter
MFG_NOMINAL_DIAMETER: Nominal diameter of the machined feature
MFG_JUMP_DIST: Jump distance

Computed parameters are as follows (see Figure 1 and Figure 2 above):

MFG_DETAIL_DEPTH: Hole depth that is effectively machined.
MFG_TOTAL_DEPTH: Total depth machined by the operation. This includes the hole depth, breakthrough, and tool tip length.
MFG_TOTAL_DEPTH_COMP: Total depth machined by the operation up to the tool compensation point selected for the operation. This includes hole depth, breakthrough and tool tip length up to the compensation point.
MFG_PLUNGE_DIST: Whatever the selected plunge mode (by Tip or by Diameter), this parameter returns the plunge distance. The plunge offset is taken into account in this value.
MFG_CMP_DWL_TIME: Computed dwell delay (in time units of seconds): this parameter is computed if dwell mode is set to 'revolutions'. Otherwise, the dwell time is returned as is.
MFG_EFFCT_DEPTH: Effective depth (= maximum depth of cut)

Default syntax: CYCLE/BRKCHP,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP

NC_CIRCULAR_MILLING

General parameters are as follows:

MFG_MO_TYPE: Machining operation type
MFG_MO_IDENTIFIER: Machining operation name or identifier
MFG_PATTERN_NAME: Machining pattern name.

Feeds and Speeds parameters are as follows:

MFG_FEED_APP_VALUE and MFG_FEED_APPRCH (compatibility V4): Approach feedrate
MFG_FEED_PLUNGE_MODE and MFG_FEED_PL_TYPE (compatibility V4): Plunge feedrate mode (0: Value / 1: Rapid)
MFG_FEED_PLUNGE_VALUE and MFG_PLUNGE_FEED (compatibility V4): Plunge feedrate
MFG_FEED_MACH_VALUE and MFG_FEED_MACH (compatibility V4): Machining feedrate
MFG_SPINDLE_MACH_VALUE and MFG_SPNDL_MACH (compatibility V4): Machining spindle speed
MFG_FEED_RETRACT_VALUE and MFG_FEED_RETRACT (compatibility V4): Retract feedrate
MFG_FEED_UNIT: Feedrate unit
MFG_SPNDL_UNIT: Spindle speed unit

Machining Strategy parameters are as follows:

MFG_CLEAR_TIP: Approach clearance
MFG_RADIAL_STEP: Distance between paths
MFG_RADIAL_NB: Number of paths
MFG_AXIAL_STRAT: Axial mode (1: Max depth of cut / 2: Number of levels / 3: Number of levels without top)
MFG_AXIAL_DEPTH: Maximum depth of cut
MFG_AXIAL_NUMBER: Number of levels
MFG_SEQUENCING_STRAT: Sequencing mode (1: Radial first / 2: Axial first)
MFG_TOLER_MACH: Machining tolerance
MFG_DIR_CUT: Direction of cut (1: Climb / 2: Conventional)
MFG_OVERHANG: Percentage overlap
MFG_DRAFT_ANGLE: Automatic draft angle
MFG_CIRCULAR_MODE: Machining mode (1: Standard / 2: Helical)
MFG_HELIX_MODE: Helix mode (1: By pitch / 2: By angle)
MFG_HELIX_ANGLE: Helix angle
MFG_PITCH: Helix pitch
MFG_TOOL_COMP and MFG_TL_COMP (compatibility V4): Length number of current corrector
MFG_TOOL_COMP_1: Length number of first corrector
MFG_TOOL_COMP_DIST: Distance between the position of the current corrector and the tool tip
MFG_TOOL_COMP_DIST_1: Distance between the position of the first corrector and the tool tip

Geometry parameters are as follows:

MFG_DIAMETER: Nominal diameter of hole (offset on contour is taken into account in this value)
MFG_JUMP_DIST: Jump distance

Computed parameters are as follows (see Figure 1 and Figure 2 above):

MFG_DETAIL_DEPTH: Hole depth that is effectively machined.
MFG_TOTAL_DEPTH: Total depth machined by the operation. This includes the hole depth, breakthrough, and tool tip length.
MFG_TOTAL_DEPTH_COMP: Total depth machined by the operation up to the tool compensation point selected for the operation. This includes hole depth, breakthrough and tool tip length up to the compensation point.

Default syntax: CYCLE/CIRCULARMILLING,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP

NC_COUNTERBORING

General parameters are as follows:

MFG_MO_TYPE: Machining operation type
MFG_MO_IDENTIFIER: Machining operation name or identifier
MFG_PATTERN_NAME: Machining pattern name.

Feeds and Speeds parameters are as follows:

MFG_FEED_APP_MODE: Approach feedrate mode (0: Value / 1: Rapid)
MFG_FEED_APP_VALUE and MFG_FEED_APPRCH (compatibility V4): Approach feedrate
MFG_FEED_PLUNGE_MODE and MFG_FEED_PL_TYPE (compatibility V4): Plunge feedrate mode (0: Value / 1: Rapid)
MFG_FEED_PLUNGE_VALUE and MFG_PLUNGE_FEED (compatibility V4): Plunge feedrate
MFG_FEED_MACH_VALUE and MFG_FEED_MACH (compatibility V4): Machining feedrate
MFG_SPINDLE_MACH_VALUE and MFG_SPNDL_MACH (compatibility V4): Machining spindle speed
MFG_FEED_RETRACT_MODE and MFG_FEED_RT_TYPE (compatibility V4): Retract feedrate mode (0: Value / 1: Rapid)
MFG_FEED_RETRACT_VALUE and MFG_FEED_RETRACT (compatibility V4): Retract feedrate
MFG_FEED_UNIT: Feedrate unit
MFG_SPNDL_UNIT: Spindle speed unit

Machining Strategy parameters are as follows:

MFG_CLEAR_TIP: Approach clearance
MFG_DEPTH_MODE: Depth mode (1: Tip / 2: Shoulder)
MFG_PLUNGE_MODE: Plunge mode (0: None / 1: Tip / 3: Diameter)
MFG_PLUNGE_TIP: Plunge tip distance
MFG_PLUNGE_OFFST: Plunge tip offset
MFG_PLUNGE_DIAMETER: Plunge diameter
MFG_DWELL_MODE: Dwell mode (0: None / 1: By revolutions / 2: By time)
MFG_DWELL_REVOL: Dwell delay in revolutions
MFG_DWELL_TIME: Dwell delay in time units (seconds)
MFG_TOOL_COMP and MFG_TL_COMP (compatibility V4): Length number of current corrector
MFG_TOOL_COMP_1: Length number of first corrector
MFG_TOOL_COMP_DIST: Distance between the position of the current corrector and the tool tip
MFG_TOOL_COMP_DIST_1: Distance between the position of the first corrector and the tool tip

Geometry parameters are as follows:

MFG_DIAMETER: Nominal diameter of the tool
MFG_NOMINAL_DIAMETER: Nominal diameter of the machined feature
MFG_JUMP_DIST: Jump distance

Computed parameters are as follows (see Figure 1 and Figure 2 above):

MFG_DETAIL_DEPTH: Hole depth that is effectively machined.
MFG_TOTAL_DEPTH: Total depth machined by the operation. This includes the hole depth, breakthrough, and tool tip length.
MFG_TOTAL_DEPTH_COMP: Total depth machined by the operation up to the tool compensation point selected for the operation. This includes hole depth, breakthrough and tool tip length up to the compensation point.
MFG_PLUNGE_DIST: Whatever the selected plunge mode (by Tip or by Diameter), this parameter returns the plunge distance. The plunge offset is taken into account in this value.
MFG_CMP_DWL_TIME: Computed dwell delay (in time units of seconds): this parameter is computed if dwell mode is set to 'revolutions'. Otherwise, the dwell time is returned as is.

Default syntax: CYCLE/BORE,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP

NC_COUNTERSINKING

General parameters are as follows:

MFG_MO_TYPE: Machining operation type
MFG_MO_IDENTIFIER: Machining operation name or identifier
MFG_PATTERN_NAME: Machining pattern name.

Feeds and Speeds parameters are as follows:

MFG_FEED_APP_MODE: Approach feedrate mode (0: Value / 1: Rapid)
MFG_FEED_APP_VALUE and MFG_FEED_APPRCH (compatibility V4): Approach feedrate
MFG_FEED_PLUNGE_MODE and MFG_FEED_PL_TYPE (compatibility V4): Plunge feedrate mode (0: Value / 1: Rapid)
MFG_FEED_PLUNGE_VALUE and MFG_PLUNGE_FEED (compatibility V4): Plunge feedrate
MFG_FEED_MACH_VALUE and MFG_FEED_MACH (compatibility V4): Machining feedrate
MFG_SPINDLE_MACH_VALUE and MFG_SPNDL_MACH (compatibility V4): Machining spindle speed
MFG_FEED_RETRACT_MODE and MFG_FEED_RT_TYPE (compatibility V4): Retract feedrate mode (0: Value / 1: Rapid)
MFG_FEED_RETRACT_VALUE and MFG_FEED_RETRACT (compatibility V4): Retract feedrate
MFG_FEED_UNIT: Feedrate unit
MFG_SPNDL_UNIT: Spindle speed unit

Machining Strategy parameters are as follows:

MFG_CLEAR_TIP: Approach clearance
MFG_DEPTH_MODE: Depth mode (3: Diameter / 4: Distance). See Figure 4 above.
MFG_PLUNGE_MODE: Plunge mode (0: None / 1: Tip / 3: Diameter).
MFG_PLUNGE_TIP: Plunge tip distance
MFG_PLUNGE_OFFST: Plunge tip offset
MFG_PLUNGE_DIAMETER: Plunge diameter
MFG_DWELL_MODE: Dwell mode (0: None / 1: By revolutions / 2: By time)
MFG_DWELL_REVOL: Dwell delay in revolutions
MFG_DWELL_TIME: Dwell delay in time units (seconds)
MFG_TOOL_COMP and MFG_TL_COMP (compatibility V4): Length number of current corrector
MFG_TOOL_COMP_1: Length number of first corrector
MFG_TOOL_COMP_DIST: Distance between the position of the current corrector and the tool tip
MFG_TOOL_COMP_DIST_1: Distance between the position of the first corrector and the tool tip

Geometry parameters are as follows:

MFG_DIAMETER: Countersink diameter
MFG_NOMINAL_DIAMETER: Nominal diameter of the machined feature
MFG_JUMP_DIST: Jump distance

Computed parameters are as follows (see Figure 4 above):

MFG_DETAIL_DEPTH: Hole depth that is effectively machined.
MFG_TOTAL_DEPTH: Total depth machined by the operation. This includes the hole depth and breakthrough.
MFG_TOTAL_DEPTH_COMP: Total depth machined by the operation up to the tool compensation point selected for the operation. This includes hole depth, breakthrough and tool tip length up to the compensation point.
MFG_PLUNGE_DIST: Whatever the selected plunge mode (by Tip or by Diameter), this parameter returns the plunge distance. The plunge offset is taken into account in this value.
MFG_CMP_DWL_TIME: Computed dwell delay (in time units of seconds): this parameter is computed if dwell mode is set to 'revolutions'. Otherwise, the dwell time is returned as is.

Default syntax: CYCLE/CSINK,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP

NC_DEEPHOLE

General parameters are as follows:

MFG_MO_TYPE: Machining operation type
MFG_MO_IDENTIFIER: Machining operation name or identifier
MFG_PATTERN_NAME: Machining pattern name.

Feeds and Speeds parameters are as follows:

MFG_FEED_APP_MODE: Approach feedrate mode (0: Value / 1: Rapid)
MFG_FEED_APP_VALUE and MFG_FEED_APPRCH (compatibility V4): Approach feedrate
MFG_FEED_PLUNGE_MODE and MFG_FEED_PL_TYPE (compatibility V4): Plunge feedrate mode (0: Value / 1: Rapid)
MFG_FEED_PLUNGE_VALUE and MFG_PLUNGE_FEED (compatibility V4): Plunge feedrate
MFG_FEED_MACH_VALUE and MFG_FEED_MACH (compatibility V4): Machining feedrate
MFG_SPINDLE_MACH_VALUE and MFG_SPNDL_MACH (compatibility V4): Machining spindle speed
MFG_FEED_RETRACT_MODE and MFG_FEED_RT_TYPE (compatibility V4): Retract feedrate mode (0: Value / 1: Rapid)
MFG_FEED_RETRACT_VALUE and MFG_FEED_RETRACT (compatibility V4): Retract feedrate
MFG_FEED_UNIT: Feedrate unit
MFG_SPNDL_UNIT: Spindle speed unit

Machining Strategy parameters are as follows:

MFG_CLEAR_TIP: Approach clearance
MFG_DEPTH_MODE: Depth mode (1: Tip / 2: Shoulder)
MFG_BREAKTHROUGH: Breakthrough distance
MFG_PLUNGE_MODE: Plunge mode  (0: None / 1: Tip / 3: Diameter)
MFG_PLUNGE_TIP: Plunge tip distance
MFG_PLUNGE_OFFST: Plunge tip offset
MFG_PLUNGE_DIAMETER: Plunge diameter
MFG_DWELL_MODE: Dwell mode (0: None / 1: By revolutions / 2: By time)
MFG_DWELL_REVOL: Dwell delay in revolutions
MFG_DWELL_TIME: Dwell delay in time units (seconds)
MFG_AXIAL_DEPTH: Maximum depth of cut
MFG_OFFSET_RET: Retract offset 
MFG_DEPTH_DEC: Decrement rate 
MFG_DEPTH_LIM: Decrement limit 
MFG_TOOL_COMP and MFG_TL_COMP (compatibility V4): Length number of current corrector
MFG_TOOL_COMP_1: Length number of first corrector
MFG_TOOL_COMP_DIST: Distance between the position of the current corrector and the tool tip
MFG_TOOL_COMP_DIST_1: Distance between the position of the first corrector and the tool tip

Geometry parameters are as follows:

MFG_DIAMETER: Nominal diameter of the tool
MFG_NOMINAL_DIAMETER: Nominal diameter of the machined feature
MFG_JUMP_DIST: Jump distance

Computed parameters are as follows (see Figure 1 and Figure 2 above):

MFG_DETAIL_DEPTH: Hole depth that is effectively machined.
MFG_TOTAL_DEPTH: Total depth machined by the operation. This includes the hole depth, breakthrough, and tool tip length.
MFG_TOTAL_DEPTH_COMP: Total depth machined by the operation up to the tool compensation point selected for the operation. This includes hole depth, breakthrough and tool tip length up to the compensation point.
MFG_PLUNGE_DIST: Whatever the selected plunge mode (by Tip or by Diameter), this parameter returns the plunge distance. The plunge offset is taken into account in this value.
MFG_CMP_DWL_TIME: Computed dwell delay (in time units of seconds): this parameter is computed if dwell mode is set to 'revolutions'. Otherwise, the dwell time is returned as is.
MFG_EFFCT_DEPTH: Effective depth (= Maximum depth of cut)

Default syntax: CYCLE/DEEPHL,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP

NC_DRILLING

General parameters are as follows:

MFG_MO_TYPE: Machining operation type
MFG_MO_IDENTIFIER: Machining operation name or identifier
MFG_PATTERN_NAME: Machining pattern name.

Feeds and Speeds parameters are as follows:

MFG_FEED_APP_MODE: Approach feedrate mode (0: Value / 1: Rapid)
MFG_FEED_APP_VALUE and MFG_FEED_APPRCH (compatibility V4): Approach feedrate
MFG_FEED_PLUNGE_MODE and MFG_FEED_PL_TYPE (compatibility V4): Plunge feedrate mode (0: Value / 1: Rapid)
MFG_FEED_PLUNGE_VALUE and MFG_PLUNGE_FEED (compatibility V4): Plunge feedrate
MFG_FEED_MACH_VALUE and MFG_FEED_MACH (compatibility V4): Machining feedrate
MFG_SPINDLE_MACH_VALUE and MFG_SPNDL_MACH (compatibility V4): Machining spindle speed
MFG_FEED_RETRACT_MODE and MFG_FEED_RT_TYPE (compatibility V4): Retract feedrate mode (0: Value / 1: Rapid)
MFG_FEED_RETRACT_VALUE and MFG_FEED_RETRACT (compatibility V4): Retract feedrate
MFG_FEED_UNIT: Feedrate unit
MFG_SPNDL_UNIT: Spindle speed unit

Machining Strategy parameters are as follows:

MFG_CLEAR_TIP: Approach clearance
MFG_DEPTH_MODE: Depth mode (1: Tip / 2: Shoulder)
MFG_BREAKTHROUGH: Breakthrough distance
MFG_PLUNGE_MODE: Plunge mode  (0: None / 1: Tip / 3: Diameter)
MFG_PLUNGE_TIP: Plunge tip distance
MFG_PLUNGE_OFFST: Plunge tip offset
MFG_PLUNGE_DIAMETER: Plunge diameter
MFG_TOOL_COMP and MFG_TL_COMP (compatibility V4): Length number of current corrector
MFG_TOOL_COMP_1: Length number of first corrector
MFG_TOOL_COMP_DIST: Distance between the position of the current corrector and the tool tip
MFG_TOOL_COMP_DIST_1: Distance between the position of the first corrector and the tool tip

Geometry parameters are as follows:

MFG_DIAMETER: Nominal diameter of the tool
MFG_NOMINAL_DIAMETER: Nominal diameter of the machined feature
MFG_JUMP_DIST: Jump distance

Computed parameters are as follows (see Figure 1 and Figure 2 above):

MFG_DETAIL_DEPTH: Hole depth that is effectively machined.
MFG_TOTAL_DEPTH: Total depth machined by the operation. This includes the hole depth, breakthrough, and tool tip length.
MFG_TOTAL_DEPTH_COMP: Total depth machined by the operation up to the tool compensation point selected for the operation. This includes hole depth, breakthrough and tool tip length up to the compensation point.
MFG_PLUNGE_DIST: Whatever the selected plunge mode (by Tip or by Diameter), this parameter returns the plunge distance. The plunge offset is taken into account in this value.

Default syntax: CYCLE/DRILL,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP,%MFG_FEED_MACH,&MFG_FEED_UNIT

NC_DRILLING_DWELL_DELAY

General parameters are as follows:

MFG_MO_TYPE: Machining operation type
MFG_MO_IDENTIFIER: Machining operation name or identifier
MFG_PATTERN_NAME: Machining pattern name.

Feeds and Speeds parameters are as follows:

MFG_FEED_APP_MODE: Approach feedrate mode (0: Value / 1: Rapid)
MFG_FEED_APP_VALUE and MFG_FEED_APPRCH (compatibility V4): Approach feedrate
MFG_FEED_PLUNGE_MODE and MFG_FEED_PL_TYPE (compatibility V4): Plunge feedrate mode (0: Value / 1: Rapid)
MFG_FEED_PLUNGE_VALUE and MFG_PLUNGE_FEED (compatibility V4): Plunge feedrate
MFG_FEED_MACH_VALUE and MFG_FEED_MACH (compatibility V4): Machining feedrate
MFG_SPINDLE_MACH_VALUE and MFG_SPNDL_MACH (compatibility V4): Machining spindle speed
MFG_FEED_RETRACT_MODE and MFG_FEED_RT_TYPE (compatibility V4): Retract feedrate mode (0: Value / 1: Rapid)
MFG_FEED_RETRACT_VALUE and MFG_FEED_RETRACT (compatibility V4): Retract feedrate
MFG_FEED_UNIT: Feedrate unit
MFG_SPNDL_UNIT: Spindle speed unit

Machining Strategy parameters are as follows:

MFG_CLEAR_TIP: Approach clearance
MFG_DEPTH_MODE: Depth mode (1: Tip / 2: Shoulder)
MFG_BREAKTHROUGH: Breakthrough distance
MFG_PLUNGE_MODE: Plunge mode (0: None / 1: Tip / 3: Diameter)
MFG_PLUNGE_TIP: Plunge tip distance
MFG_PLUNGE_OFFST: Plunge tip offset
MFG_PLUNGE_DIAMETER: Plunge diameter
MFG_DWELL_MODE: Dwell mode (0: None / 1: By revolutions / 2: By time)
MFG_DWELL_REVOL: Dwell delay in revolutions
MFG_DWELL_TIME: Dwell delay in time units (seconds)
MFG_TOOL_COMP and MFG_TL_COMP (compatibility V4): Length number of current corrector
MFG_TOOL_COMP_1: Length number of first corrector
MFG_TOOL_COMP_DIST: Distance between the position of the current corrector and the tool tip
MFG_TOOL_COMP_DIST_1: Distance between the position of the first corrector and the tool tip

Geometry parameters are as follows:

MFG_DIAMETER: Nominal diameter of the tool
MFG_NOMINAL_DIAMETER: Nominal diameter of the machined feature
MFG_JUMP_DIST: Jump distance

Computed parameters are as follows (see Figure 1 and Figure 2 above):

MFG_DETAIL_DEPTH: Hole depth that is effectively machined.
MFG_TOTAL_DEPTH: Total depth machined by the operation. This includes the hole depth, breakthrough, and tool tip length.
MFG_TOTAL_DEPTH_COMP: Total depth machined by the operation up to the tool compensation point selected for the operation. This includes hole depth, breakthrough and tool tip length up to the compensation point.
MFG_PLUNGE_DIST: Whatever the selected plunge mode (by Tip or by Diameter), this parameter returns the plunge distance. The plunge offset is taken into account in this value.
MFG_CMP_DWL_TIME: Computed dwell delay (in time units of seconds): this parameter is computed if dwell mode is set to 'revolutions'. Otherwise, the dwell time is returned as is.

Default syntax: CYCLE/DRILL,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP

NC_LATHE_THREADING

General parameters are as follows:

MFG_MO_TYPE: Machining operation type
MFG_MO_IDENTIFIER: Machining operation name or identifier.

Machining Strategy parameters are as follows:

MFG_THREAD_MACHINING: Machining type (1: Constant depth / 2: Section of cut)
MFG_THREAD_PENETRATION: Penetration (1: Straight / 2: Flank / 3: Alternate)
MFG_THREAD_UNIT: Unit (1: Pitch / 2: Thread per inch)
MFG_THREAD_PROFILE: Profile (1: ISO / 2: Trapezoidal / 3: UNC / 4: Gaz)
MFG_THREAD_ORIENTATION: Orientation (1: Internal / 2: External)

MFG_THREAD_PITCH: Thread pitch 
MFG_NUM_THREADS: Number of threads 
MFG_THRD_PER_UNIT: Threads per inch

MFG_FIR_PATH: Boolean for first passes  (0: No / 1: Yes)
MFG_LAS_PATH: Boolean for last passes (0: No / 1: Yes)
MFG_SPR_PATH: Boolean for spring passes (0: No / 1: Yes)
MFG_NUM_FIR_PATH: Number of first passes 
MFG_NUM_LAS_PATH: Number of last passes
MFG_NUM_SPR_PATH: Number of spring passes
MFG_FIR_SECT_CUT: Section of cut for first passes 
MFG_LAS_DEPT_CUT: Depth of cut for last passes 
MFG_FIR_SECT_RAT: Section ratio between first passes and next passes

MFG_CRES_DIA_CLR: Clearance on crest diameter 
MFG_ENTER_ANG: Entry angle 
MFG_LEAD_IN_DIST: Lead-in distance 
MFG_LIFT_OFF_ANG: Lift-off angle
MFG_LIFT_OFF_DIS: Lift-off distance

MFG_SPNDL_UNIT: list with two values defining the spindle rotation units.
First value: spindle rotation expressed in revolutions per minute. RPM is the default value.
Second value: spindle rotation expressed in surface meters per minute. SMM is the default value.
MFG_SPNDL_WAY: list with two values defining the direction of rotation of the spindle.
First value: spindle rotation processed clockwise. CLW is the default value.
Second value: spindle rotation processed counter-clockwise. CCLW is the default value.
MFG_SPNDL_SPEED: numerical value of the spindle speed.

Computed parameters are as follows:

MFG_ST_THRD_AX: Axial coordinate of the start thread on the crest. 
MFG_ST_THRD_RAD: Radial coordinate of the start thread on the crest. 
MFG_END_THRD_AX: Axial coordinate of the end thread on the crest. 
MFG_END_THRD_RAD: Radial coordinate of the end thread on the crest. 
MFG_END_THRD1_AX: Axial coordinate of the end thread on the root. 
MFG_END_THRD1_RAD: Radial coordinate of the end thread on the root. 
MFG_THRD_DEL_RAD: Depth of thread according to the radial axis.
MFG_THRD_ANG: Angle of the thread. If different from zero, this angle indicates a conical thread. 
MFG_NOM_DIAM: Nominal diameter of the thread. 
MFG_THRD_LENGTH: Length of the thread. 
MFG_NB_PATH: Number of passes. First, last and spring passes are not included. 
MFG_DEPTH_CUT: Depth of cut. 
MFG_SECTION_CUT: Section of cut for passes that follow the first passes. 
MFG_THREAD_DEPTH: Depth of thread.

Default syntax: CYCLE/THREAD,%MFG_THREAD_PITCH

NC_REAMING

General parameters are as follows:

MFG_MO_TYPE: Machining operation type
MFG_MO_IDENTIFIER: Machining operation name or identifier
MFG_PATTERN_NAME: Machining pattern name.

Feeds and Speeds parameters are as follows:

MFG_FEED_APP_MODE: Approach feedrate mode (0: Value / 1: Rapid)
MFG_FEED_APP_VALUE and MFG_FEED_APPRCH (compatibility V4): Approach feedrate
MFG_FEED_PLUNGE_MODE and MFG_FEED_PL_TYPE (compatibility V4): Plunge feedrate mode (0: Value / 1: Rapid)
MFG_FEED_PLUNGE_VALUE and MFG_PLUNGE_FEED (compatibility V4): Plunge feedrate
MFG_FEED_MACH_VALUE and MFG_FEED_MACH (compatibility V4): Machining feedrate
MFG_SPINDLE_MACH_VALUE and MFG_SPNDL_MACH (compatibility V4): Machining spindle speed
MFG_FEED_RETRACT_MODE and MFG_FEED_RT_TYPE (compatibility V4): Retract feedrate mode (0: Value / 1: Rapid)
MFG_FEED_RETRACT_VALUE and MFG_FEED_RETRACT (compatibility V4): Retract feedrate
MFG_FEED_UNIT: Feedrate unit
MFG_SPNDL_UNIT: Spindle speed unit

Machining Strategy parameters are as follows:

MFG_CLEAR_TIP: Approach clearance
MFG_DEPTH_MODE: Depth mode (1: Tip / 2: Shoulder)
MFG_BREAKTHROUGH: Breakthrough distance
MFG_PLUNGE_MODE: Plunge mode (0: None / 1: Tip / 3: Diameter)
MFG_PLUNGE_TIP: Plunge tip distance
MFG_PLUNGE_OFFST: Plunge tip offset
MFG_PLUNGE_DIAMETER: Plunge diameter
MFG_DWELL_MODE: Dwell mode (0: None / 1: By revolutions / 2: By time)
MFG_DWELL_REVOL: Dwell delay in revolutions
MFG_DWELL_TIME: Dwell delay in time units (seconds)
MFG_TOOL_COMP and MFG_TL_COMP (compatibility V4): Length number of current corrector
MFG_TOOL_COMP_1: Length number of first corrector
MFG_TOOL_COMP_DIST: Distance between the position of the current corrector and the tool tip
MFG_TOOL_COMP_DIST_1: Distance between the position of the first corrector and the tool tip

Geometry parameters are as follows:

MFG_DIAMETER: Nominal diameter of the tool
MFG_NOMINAL_DIAMETER: Nominal diameter of the machined feature
MFG_JUMP_DIST: Jump distance

Computed parameters are as follows (see Figure 1 and Figure 2 above):

MFG_DETAIL_DEPTH: Hole depth that is effectively machined.
MFG_TOTAL_DEPTH: Total depth machined by the operation. This includes the hole depth, breakthrough, and tool tip length.
MFG_TOTAL_DEPTH_COMP: Total depth machined by the operation up to the tool compensation point selected for the operation. This includes hole depth, breakthrough and tool tip length up to the compensation point.
MFG_PLUNGE_DIST: Whatever the selected plunge mode (by Tip or by Diameter), this parameter returns the plunge distance. The plunge offset is taken into account in this value.
MFG_CMP_DWL_TIME: Computed dwell delay (in time units of seconds): this parameter is computed if dwell mode is set to 'revolutions'. Otherwise, the dwell time is returned as is.

Default syntax: CYCLE/REAM,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP

NC_REVERSE_THREADING

General parameters are as follows:

MFG_MO_TYPE: Machining operation type
MFG_MO_IDENTIFIER: Machining operation name or identifier
MFG_PATTERN_NAME: Machining pattern name.

Feeds and Speeds parameters are as follows:

MFG_FEED_APP_MODE: Approach feedrate mode (0: Value / 1: Rapid)
MFG_FEED_APP_VALUE and MFG_FEED_APPRCH (compatibility V4): Approach feedrate
MFG_FEED_PLUNGE_MODE and MFG_FEED_PL_TYPE (compatibility V4): Plunge feedrate mode (0: Value / 1: Rapid)
MFG_FEED_PLUNGE_VALUE and MFG_PLUNGE_FEED (compatibility V4): Plunge feedrate
MFG_FEED_MACH_VALUE and MFG_FEED_MACH (compatibility V4): Machining feedrate
MFG_SPINDLE_MACH_VALUE and MFG_SPNDL_MACH (compatibility V4): Machining spindle speed
MFG_FEED_RETRACT_MODE and MFG_FEED_RT_TYPE (compatibility V4): Retract feedrate mode (0: Value / 1: Rapid)
MFG_FEED_RETRACT_VALUE and MFG_FEED_RETRACT (compatibility V4): Retract feedrate
MFG_FEED_UNIT: Feedrate unit
MFG_SPNDL_UNIT: Spindle speed unit

Machining Strategy parameters are as follows:

MFG_CLEAR_TIP: Approach clearance
MFG_DEPTH_MODE: Depth mode (1: Tip / 2: Shoulder)
MFG_BREAKTHROUGH: Breakthrough distance
MFG_PLUNGE_MODE: Plunge mode (0: None / 1: Tip)
MFG_PLUNGE_TIP: Plunge tip distance
MFG_PLUNGE_OFFST: Plunge tip offset
MFG_TOOL_COMP and MFG_TL_COMP (compatibility V4): Length number of current corrector
MFG_TOOL_COMP_1: Length number of first corrector
MFG_TOOL_COMP_DIST: Distance between the position of the current corrector and the tool tip
MFG_TOOL_COMP_DIST_1: Distance between the position of the first corrector and the tool tip

Geometry parameters are as follows:

MFG_DIAMETER: Internal diameter of the tool
MFG_THREAD_DIAMETER: Nominal diameter of the tool
MFG_JUMP_DIST: Jump distance

Computed parameters are as follows (see Figure 1 and Figure 2 above):

MFG_DETAIL_DEPTH: Hole depth that is effectively machined.
MFG_TOTAL_DEPTH: Total depth machined by the operation. This includes the hole depth, breakthrough, and tool tip length.
MFG_TOTAL_DEPTH_COMP: Total depth machined by the operation up to the tool compensation point selected for the operation. This includes hole depth, breakthrough and tool tip length up to the compensation point.
MFG_PLUNGE_DIST: This parameter returns the plunge distance. The plunge offset is taken into account in this value.
MFG_TOOL_PITCH: Pitch value defined on tool.

Default syntax: CYCLE/TAP,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP

NC_SPOT_DRILLING

General parameters are as follows:

MFG_MO_TYPE: Machining operation type
MFG_MO_IDENTIFIER: Machining operation name or identifier
MFG_PATTERN_NAME: Machining pattern name.

Feeds and Speeds parameters are as follows:

MFG_FEED_APP_MODE: Approach feedrate mode (0: Value / 1: Rapid)
MFG_FEED_APP_VALUE and MFG_FEED_APPRCH (compatibility V4): Approach feedrate
MFG_FEED_PLUNGE_MODE and MFG_FEED_PL_TYPE (compatibility V4): Plunge feedrate mode (0: Value / 1: Rapid)
MFG_FEED_PLUNGE_VALUE and MFG_PLUNGE_FEED (compatibility V4): Plunge feedrate
MFG_FEED_MACH_VALUE and MFG_FEED_MACH (compatibility V4): Machining feedrate
MFG_SPINDLE_MACH_VALUE and MFG_SPNDL_MACH (compatibility V4): Machining spindle speed
MFG_FEED_RETRACT_MODE and MFG_FEED_RT_TYPE (compatibility V4): Retract feedrate mode (0: Value / 1: Rapid)
MFG_FEED_RETRACT_VALUE and MFG_FEED_RETRACT (compatibility V4): Retract feedrate
MFG_FEED_UNIT: Feedrate unit
MFG_SPNDL_UNIT: Spindle speed unit

Machining Strategy parameters are as follows:

MFG_CLEAR_TIP: Approach clearance
MFG_DEPTH_MODE: Depth mode (1: Tip / 2: Shoulder). See Figure 3 above.
MFG_BREAKTHROUGH: Breakthrough distance
MFG_PLUNGE_MODE: Plunge mode (0: None / 1: Tip / 3: Diameter).
MFG_PLUNGE_TIP: Plunge tip distance
MFG_PLUNGE_OFFST: Plunge tip offset
MFG_PLUNGE_DIAMETER: Plunge diameter
MFG_DWELL_MODE: Dwell mode (0: None / 1: By revolutions / 2: By time)
MFG_DWELL_REVOL: Dwell delay in revolutions
MFG_DWELL_TIME: Dwell delay in time units (seconds)
MFG_TOOL_COMP and MFG_TL_COMP (compatibility V4): Length number of current corrector
MFG_TOOL_COMP_1: Length number of first corrector
MFG_TOOL_COMP_DIST: Distance between the position of the current corrector and the tool tip
MFG_TOOL_COMP_DIST_1: Distance between the position of the first corrector and the tool tip

Geometry parameters are as follows:

MFG_DIAMETER: Chamfer diameter
MFG_JUMP_DIST: Jump distance

Computed parameters are as follows (see Figure 3 above):

MFG_DETAIL_DEPTH: Hole depth that is effectively machined.
MFG_TOTAL_DEPTH: Total depth machined by the operation. This includes the hole depth and plunge distance.
MFG_TOTAL_DEPTH_COMP: Total depth machined by the operation up to the tool compensation point selected for the operation. This includes hole depth, breakthrough and tool tip length up to the compensation point.
MFG_PLUNGE_DIST: Whatever the selected plunge mode (by Tip or by Diameter), this parameter returns the plunge distance. The plunge offset is taken into account in this value.
MFG_CMP_DWL_TIME: Computed dwell delay (in time units of seconds): this parameter is computed if dwell mode is set to 'revolutions'. Otherwise, the dwell time is returned as is.

Default syntax: CYCLE/DRILL,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP

NC_T_SLOTTING

General parameters are as follows:

MFG_MO_TYPE: Machining operation type
MFG_MO_IDENTIFIER: Machining operation name or identifier
MFG_PATTERN_NAME: Machining pattern name.

Feeds and Speeds parameters are as follows:

MFG_FEED_APP_MODE: Approach feedrate mode (0: Value / 1: Rapid)
MFG_FEED_APP_VALUE and MFG_FEED_APPRCH (compatibility V4): Approach feedrate
MFG_FEED_PLUNGE_MODE and MFG_FEED_PL_TYPE (compatibility V4): Plunge feedrate mode (0: Value / 1: Rapid)
MFG_FEED_PLUNGE_VALUE and MFG_PLUNGE_FEED (compatibility V4): Plunge feedrate
MFG_FEED_MACH_VALUE and MFG_FEED_MACH (compatibility V4): Machining feedrate
MFG_SPINDLE_MACH_VALUE and MFG_SPNDL_MACH (compatibility V4): Machining spindle speed
MFG_FEED_RETRACT_MODE and MFG_FEED_RT_TYPE (compatibility V4): Retract feedrate mode (0: Value / 1: Rapid)
MFG_FEED_RETRACT_VALUE and MFG_FEED_RETRACT (compatibility V4): Retract feedrate
MFG_FEED_UNIT: Feedrate unit
MFG_SPNDL_UNIT: Spindle speed unit

Machining Strategy parameters are as follows:

MFG_CLEAR_TIP: Approach clearance
MFG_DEPTH_MODE: Depth mode (1: Tip)
MFG_DIR_CUT: Direction of cut (1: Climb / 2: Conventional)
MFG_DWELL_MODE: Dwell mode (0: None / 1: By revolutions / 2: By time)
MFG_DWELL_REVOL: Dwell delay in revolutions
MFG_DWELL_TIME: Dwell delay in time units (seconds)
MFG_TOOL_COMP and MFG_TL_COMP (compatibility V4): Length number of current corrector
MFG_TOOL_COMP_1: Length number of first corrector
MFG_TOOL_COMP_DIST: Distance between the position of the current corrector and the tool tip
MFG_TOOL_COMP_DIST_1: Distance between the position of the first corrector and the tool tip

Geometry parameters are as follows:

MFG_DIAMETER: Slot diameter
MFG_NOMINAL_DIAMETER: Nominal diameter of the machined feature
MFG_LENGTH: Slot height (= Tool length, which is read on tool)
MFG_JUMP_DIST: Jump distance

Computed parameters are as follows (see Figure 1 and Figure 2 above):

MFG_DETAIL_DEPTH: Hole depth that is effectively machined.
MFG_TOTAL_DEPTH: Total depth machined by the operation. This includes the hole depth, breakthrough, and tool tip length.
MFG_TOTAL_DEPTH_COMP: Total depth machined by the operation up to the tool compensation point selected for the operation. This includes hole depth, breakthrough and tool tip length up to the compensation point.
MFG_CMP_DWL_TIME: Computed dwell delay (in time units of seconds): this parameter is computed if dwell mode is set to 'revolutions'. Otherwise, the dwell time is returned as is.

Default syntax: CYCLE/TSLOT,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP

NC_TAPPING

General parameters are as follows:

MFG_MO_TYPE: Machining operation type
MFG_MO_IDENTIFIER: Machining operation name or identifier
MFG_PATTERN_NAME: Machining pattern name.

Feeds and Speeds parameters are as follows:

MFG_FEED_APP_MODE: Approach feedrate mode (0: Value / 1: Rapid)
MFG_FEED_APP_VALUE and MFG_FEED_APPRCH (compatibility V4): Approach feedrate
MFG_FEED_PLUNGE_MODE and MFG_FEED_PL_TYPE (compatibility V4): Plunge feedrate mode (0: Value / 1: Rapid)
MFG_FEED_PLUNGE_VALUE and MFG_PLUNGE_FEED (compatibility V4): Plunge feedrate
MFG_FEED_MACH_VALUE and MFG_FEED_MACH (compatibility V4): Machining feedrate
MFG_SPINDLE_MACH_VALUE and MFG_SPNDL_MACH (compatibility V4): Machining spindle speed
MFG_FEED_RETRACT_MODE and MFG_FEED_RT_TYPE (compatibility V4): Retract feedrate mode (0: Value / 1: Rapid)
MFG_FEED_RETRACT_VALUE and MFG_FEED_RETRACT (compatibility V4): Retract feedrate
MFG_FEED_UNIT: Feedrate unit
MFG_SPNDL_UNIT: Spindle speed unit

Machining Strategy parameters are as follows:

MFG_CLEAR_TIP: Approach clearance
MFG_DEPTH_MODE: Depth mode  (1: Tip / 2: Shoulder)
MFG_BREAKTHROUGH: Breakthrough distance
MFG_PLUNGE_MODE: Plunge mode  (0: None / 1: Tip)
MFG_PLUNGE_TIP: Plunge tip distance
MFG_PLUNGE_OFFST: Plunge tip offset
MFG_TOOL_COMP and MFG_TL_COMP (compatibility V4): Length number of current corrector
MFG_TOOL_COMP_1: Length number of first corrector
MFG_TOOL_COMP_DIST: Distance between the position of the current corrector and the tool tip
MFG_TOOL_COMP_DIST_1: Distance between the position of the first corrector and the tool tip

Geometry parameters are as follows:

MFG_DIAMETER: Internal diameter of the tool
MFG_THREAD_DIAMETER: Nominal diameter of the tool
MFG_JUMP_DIST: Jump distance

Computed parameters are as follows (see Figure 1 and Figure 2 above):

MFG_DETAIL_DEPTH: Hole depth that is effectively machined.
MFG_TOTAL_DEPTH: Total depth machined by the operation. This includes the hole depth, breakthrough, and tool tip length.
MFG_TOTAL_DEPTH_COMP: Total depth machined by the operation up to the tool compensation point selected for the operation. This includes hole depth, breakthrough and tool tip length up to the compensation point.
MFG_PLUNGE_DIST: This parameter returns the plunge distance. The plunge offset is taken into account in this value.
MFG_TOOL_PITCH: Pitch value defined on tool

Default syntax: CYCLE/TAP,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP

NC_THREAD_WITHOUT_TAP_HEAD

General parameters are as follows:

MFG_MO_TYPE: Machining operation type
MFG_MO_IDENTIFIER: Machining operation name or identifier
MFG_PATTERN_NAME: Machining pattern name.

Feeds and Speeds parameters are as follows:

MFG_FEED_APP_MODE: Approach feedrate mode (0: Value / 1: Rapid)
MFG_FEED_APP_VALUE and MFG_FEED_APPRCH (compatibility V4): Approach feedrate
MFG_FEED_PLUNGE_MODE and MFG_FEED_PL_TYPE (compatibility V4): Plunge feedrate mode (0: Value / 1: Rapid)
MFG_FEED_PLUNGE_VALUE and MFG_PLUNGE_FEED (compatibility V4): Plunge feedrate
MFG_FEED_MACH_VALUE and MFG_FEED_MACH (compatibility V4): Machining feedrate
MFG_SPINDLE_MACH_VALUE and MFG_SPNDL_MACH (compatibility V4): Machining spindle speed
MFG_FEED_RETRACT_MODE and MFG_FEED_RT_TYPE (compatibility V4): Retract feedrate mode (0: Value / 1: Rapid)
MFG_FEED_RETRACT_VALUE and MFG_FEED_RETRACT (compatibility V4): Retract feedrate
MFG_FEED_UNIT: Feedrate unit
MFG_SPNDL_UNIT: Spindle speed unit

Machining Strategy parameters are as follows:

MFG_CLEAR_TIP: Approach clearance
MFG_DEPTH_MODE: Depth mode (1: Tip)
MFG_BREAKTHROUGH: Breakthrough distance
MFG_PLUNGE_MODE: Plunge mode (0: None / 1: Tip)
MFG_PLUNGE_TIP: Plunge tip distance
MFG_PLUNGE_OFFST: Plunge tip offset
MFG_TOOL_COMP and MFG_TL_COMP (compatibility V4): Length number of current corrector
MFG_TOOL_COMP_1: Length number of first corrector
MFG_TOOL_COMP_DIST: Distance between the position of the current corrector and the tool tip
MFG_TOOL_COMP_DIST_1: Distance between the position of the first corrector and the tool tip

Geometry parameters are as follows:

MFG_DIAMETER: Hole internal diameter
MFG_THREAD_DIAMETER: Tool nominal diameter
MFG_JUMP_DIST: Jump distance

Computed parameters are as follows (see Figure 1 and Figure 2 above):

MFG_DETAIL_DEPTH: Hole depth that is effectively machined.
MFG_TOTAL_DEPTH: Total depth machined by the operation. This includes the hole depth, breakthrough, and tool tip length.
MFG_TOTAL_DEPTH_COMP: Total depth machined by the operation up to the tool compensation point selected for the operation. This includes hole depth, breakthrough and tool tip length up to the compensation point.
MFG_PLUNGE_DIST: This parameter returns the plunge distance. The plunge offset is taken into account in this value.

Default syntax: CYCLE/TAP,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP

NC_THREAD_MILLING

General parameters are as follows:

MFG_MO_TYPE: Machining operation type
MFG_MO_IDENTIFIER: Machining operation name or identifier
MFG_PATTERN_NAME: Machining pattern name.

Feeds and Speeds parameters are as follows:

MFG_FEED_APP_VALUE and MFG_FEED_APPRCH (compatibility V4): Approach feedrate
MFG_FEED_MACH_VALUE and MFG_FEED_MACH (compatibility V4): Machining feedrate
MFG_SPINDLE_MACH_VALUE and MFG_SPNDL_MACH (compatibility V4): Machining spindle speed
MFG_FEED_RETRACT_VALUE and MFG_FEED_RETRACT (compatibility V4): Retract feedrate
MFG_FEED_UNIT: Feedrate unit
MFG_SPNDL_UNIT: Spindle speed unit

Machining Strategy parameters are as follows:

MFG_THREAD_STRATEGY: Thread milling mode  (1: Mono-pass / 2: Optimized-passes)
MFG_THREAD_DIRECTION: Thread milling direction  (1: Top to bottom / 2: Bottom to top)
MFG_CLEAR_TIP: Approach clearance
MFG_BREAKTHROUGH: Breakthrough distance
MFG_TOOL_COMP and MFG_TL_COMP (compatibility V4): Length number of current corrector
MFG_TOOL_COMP_1: Length number of first corrector
MFG_TOOL_COMP_DIST: Distance between the position of the current corrector and the tool tip
MFG_TOOL_COMP_DIST_1: Distance between the position of the first corrector and the tool tip.

Geometry parameters are as follows:

MFG_DIAMETER: Hole internal diameter
MFG_THREAD_DIAMETER: Hole nominal diameter
MFG_PITCH: Thread pitch
MFG_PITCH_SENS or MFG_PITCH_WAY_OF_ROT: Thread direction (1: Left-hand / 2: Right-hand)
MFG_JUMP_DIST: Jump distance

Computed parameters are as follows (see Figure 1 and Figure 2 above):

MFG_DETAIL_DEPTH: Hole depth that is effectively machined.
MFG_TOTAL_DEPTH: Total depth machined by the operation. This includes the hole depth, breakthrough, and tool tip length.
MFG_TOTAL_DEPTH_COMP: Total depth machined by the operation up to the tool compensation point selected for the operation. This includes hole depth, breakthrough and tool tip length up to the compensation point.
MFG_TOOL_PITCH: Pitch value defined on tool

Default syntax: CYCLE/THREADMILLING,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP

NC_TWO_SIDES_CHAMFERING

General parameters are as follows:

MFG_MO_TYPE: Machining operation type
MFG_MO_IDENTIFIER: Machining operation name or identifier
MFG_PATTERN_NAME: Machining pattern name.

Feeds and Speeds parameters are as follows:

MFG_FEED_APP_MODE: Approach feedrate mode (0: Value / 1: Rapid)
MFG_FEED_APP_VALUE and MFG_FEED_APPRCH (compatibility V4): Approach feedrate
MFG_FEED_PLUNGE_MODE and MFG_FEED_PL_TYPE (compatibility V4): Plunge feedrate mode (0: Value / 1: Rapid)
MFG_FEED_PLUNGE_VALUE and MFG_PLUNGE_FEED (compatibility V4): Plunge feedrate
MFG_FEED_MACH_VALUE and MFG_FEED_MACH (compatibility V4): Machining feedrate
MFG_SPINDLE_MACH_VALUE and MFG_SPNDL_MACH (compatibility V4): Machining spindle speed
MFG_FEED_RETRACT_MODE and MFG_FEED_RT_TYPE (compatibility V4): Retract feedrate mode (0: Value / 1: Rapid)
MFG_FEED_RETRACT_VALUE and MFG_FEED_RETRACT (compatibility V4): Retract feedrate
MFG_FEED_UNIT: Feedrate unit
MFG_SPNDL_UNIT: Spindle speed unit

Machining Strategy parameters are as follows:

MFG_CLEAR_TIP: Approach clearance
MFG_CLEAR_TIP_2: Second approach clearance
MFG_DEPTH_MODE: Depth mode (1: Tip)
MFG_PLUNGE_MODE: Plunge mode (0: None / 1: Tip / 3: Diameter)
MFG_PLUNGE_TIP: Plunge tip distance
MFG_PLUNGE_OFFST: Plunge tip offset
MFG_PLUNGE_DIAMETER: Plunge diameter
MFG_DWELL_MODE: Dwell mode (0: None / 1: By revolutions / 2: By time)
MFG_DWELL_REVOL: Dwell delay in revolutions
MFG_DWELL_TIME: Dwell delay in time units (seconds)
MFG_TOOL_COMP and MFG_TL_COMP (compatibility V4): Length number of current corrector
MFG_TOOL_COMP_1: Length number of first corrector
MFG_TOOL_COMP_2: Length number of second corrector
MFG_TOOL_COMP_DIST: Distance between the position of the current corrector and the tool tip
MFG_TOOL_COMP_DIST_1: Distance between the position of the first corrector and the tool tip
MFG_TOOL_COMP_DIST_2: Distance between the position of the second corrector and the tool tip

Geometry parameters are as follows:

MFG_DIAMETER: Chamfer diameter
MFG_NOMINAL_DIAMETER: Nominal diameter of the machined feature
MFG_JUMP_DIST: Jump distance

Computed parameters are as follows (see Figure 1 and Figure 2 above):

MFG_DETAIL_DEPTH: Hole depth that is effectively machined.
MFG_TOTAL_DEPTH: Total depth machined by the operation. This includes the hole depth, breakthrough, and tool tip length.
MFG_TOTAL_DEPTH_COMP: Total depth machined by the operation up to the tool compensation point selected for the operation. This includes hole depth, breakthrough and tool tip length up to the compensation point.
MFG_PLUNGE_DIST: Whatever the selected plunge mode (by Tip or by Diameter), this parameter returns the plunge distance. The plunge offset is taken into account in this value.
MFG_CMP_DWL_TIME: Computed dwell delay (in time units of seconds): this parameter is computed if dwell mode is set to 'revolutions'. Otherwise, the dwell time is returned as is.

Default syntax: CYCLE/DRILL,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP,%MFG_FEED_MACH,&MFG_FEED_UNIT